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Errors & Fixes

SOLIDWORKS running slow — how to speed it up

SOLIDWORKS gets slow for three different reasons, and each has its own fix: the model is heavy (long rebuilds), the graphics are struggling (laggy rotation), or the files travel over a slow network (slow opening and saving). Find out which one you have first — SOLIDWORKS can tell you exactly which features eat rebuild time — then change only the settings that matter.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Large CAD assembly with a slow loading bar and a speedometer needle in the red zone

Applies to: SOLIDWORKS 2022–2027. Option names from Tools → Options in 2025–2026.

Most likely causes

  1. Heavy features: threads, patterns, in-context references, complex fillets (slow rebuilds)
  2. Large assemblies opened fully resolved with high image quality (slow opening)
  3. Integrated graphics, uncertified driver or Software OpenGL left on (laggy rotation)
  4. Files, backups or auto-recover on a network drive, VPN or sync folder (slow open/save)
  5. Too little RAM — Windows swaps to disk (slow everything)
  6. Slow add-ins and background indexing (slow start-up)

Which kind of slow do you have?

Symptom Bottleneck Start with
Every change takes ages to rebuild Processor and model complexity Fixes 1–2, CPU guide
Rotating, zooming and panning stutter Graphics card or driver Fixes 6–7, graphics cards
Opening and saving take minutes Network, VPN, disk Fixes 8–10
Everything gets slower over a session Memory, GDI objects Fix 11, low memory
Start-up alone takes minutes Add-ins, licensing, network paths Fix 9
Performance Evaluation results listing features by rebuild time with a thread feature at the top
Performance Evaluation shows which features use most of the rebuild time.

The settings that matter most

Performance options with Verification on rebuild off and Load components lightweight on
The performance options worth checking first.

Changing many options at once makes it hard to see what helped. Change one, test with the same model, and keep a note. Large assembly resellers recommend these in particular:

  • Verification on rebuild off.
  • Load components lightweight on, with Large Assembly Mode for big assemblies.
  • Image quality moderate, applied to referenced parts.
  • Enhanced Graphics Performance on (with a certified driver), Software OpenGL off.

Modelling habits that keep files fast

  • Use cosmetic threads instead of modelled helical threads. In the SOLIDWORKS team's own example, one thread feature took 87% of a part's rebuild time.
  • Avoid unnecessary in-context references in assemblies; lock or break them when the design is settled.
  • Pattern the feature, not the body, and keep pattern counts sensible.
  • Add fillets and cosmetic features last so that edits higher up do not rebuild them over and over.
  • Split very large assemblies into subassemblies and use SpeedPak or simplified configurations at the top level.

If upgrades are on the table, our system requirements guide and PC build guide show what makes the most difference for each kind of work.

Modelled threads are a common cause of slow parts — compare cosmetic threads and the Thread feature.

Faster patterns: see the performance notes in Linear Pattern; lighter variants with configurations.

Big assemblies: Large Design Review and lightweight and SpeedPak.

Fixes, in order

  1. 1. Run Performance Evaluation on the slow model

    With the part or assembly open, go to the Evaluate tab of the CommandManager → Performance Evaluation. It lists the rebuild time of each feature and its share of the total. Suppress or simplify the worst offenders: cosmetic threads instead of modelled threads, fewer pattern instances, fillets added last.

  2. 2. Turn off Verification on rebuild

    Tools → Options → System Options → Performance → Verification on rebuild: off. It runs extra geometry checks on every rebuild. Turn it on only when you are hunting a rebuild error.

  3. 3. Use Large Assembly Mode and lightweight components

    System Options → Assemblies: tick Use Large Assembly Mode and set the component count that triggers it. Also in Performance, set Load components lightweight. Large Assembly Mode switches off costly display effects such as RealView. For reviews, open with Large Design Review; for top-level work, use SpeedPak or simplified configurations of subassemblies.

  4. 4. Lower image quality

    Tools → Options → Document Properties → Image Quality: move the shaded slider towards the middle or lower and tick Apply to all referenced part documents. High tessellation makes files bigger and rotation slower, especially with curved parts.

  5. 5. Change open and rebuild options

    Set Rebuild assembly on load to Prompt, turn off shaded previews in the open dialog, and in drawings load only the sheets you need. Turn off Level of detail (or set it to Less).

  6. 6. Check Enhanced Graphics Performance and Software OpenGL

    In System Options → Performance, Enhanced Graphics Performance (on by default since 2021) speeds up display on certified cards — it needs a restart to change. Make sure Use Software OpenGL is off; it makes everything slow and greys out RealView.

  7. 7. Make a laptop use the dedicated GPU

    Windows 11: Settings → System → Display → Graphics, add SLDWORKS.exe, set High performance. Plug monitors into the ports of the dedicated card. See best GPU for SOLIDWORKS.

  8. 8. Work locally, not over the network

    SOLIDWORKS writes temporary files next to the files you open, so a network folder slows every save. Copy the files to a local SSD (or use the PDM local cache) and test. Point the Backup and Auto-recover folders to the local C: drive.

  9. 9. Turn off what runs in the background

    Set SOLIDWORKS Search indexing to idle-only or off, turn off the news feed, and untick add-ins you do not use (Tools → Add-Ins; check the Last Load Time column).

  10. 10. Clean temp and backup folders

    SOLIDWORKS Rx → System Maintenance → Start Maintenance. It clears the SOLIDWORKS backup and temp folders and Windows temp files.

  11. 11. Check memory use

    Watch Task Manager while you work. If memory is near 100% and the disk is busy, Windows is paging and you need more RAM — the official requirement is 16 GB minimum and 32 GB recommended. See how much RAM SOLIDWORKS needs.

  12. 12. Run the Performance Benchmark

    SOLIDWORKS Rx → Benchmark times processor, graphics and disk tasks (all scores in seconds — lower is better). Restart first and close other programs; it can take 30 minutes. Compare your results with shared scores to see which part of the PC holds you back.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

Why is SOLIDWORKS so slow on my new computer?

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Common reasons are a laptop running SOLIDWORKS on integrated graphics, a graphics driver that is not the certified one, Software OpenGL left on, or files opened from a network or sync folder. Large models also run slowly with Verification on rebuild switched on.

Does SOLIDWORKS use multiple CPU cores?

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Rebuilding a single part is mostly single-threaded, so a processor with a high clock speed matters most. Some tasks — such as rendering, simulation and some drawing work — use more cores.

How do I find which feature slows down my part?

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Use Performance Evaluation on the Evaluate tab. It lists every feature's rebuild time and its share of the total, sorted so the slowest ones are easy to spot.

What is Large Assembly Mode?

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A set of performance settings that SOLIDWORKS turns on when an assembly has more components than the limit you choose. It turns off costly display options, such as RealView, to keep big assemblies responsive.