Assemblies · Lesson 13
SOLIDWORKS large assemblies
Big assemblies get slow because SOLIDWORKS loads and solves everything. You can choose how much it loads: Resolved loads all data, Lightweight loads only what is needed to display and mate, and Large Design Review opens even huge assemblies quickly for viewing — and since 2019 for some editing. Large Assembly Mode switches on performance settings automatically above a component count you choose.

Where to find it
File → Open → Mode; Evaluate tab → Assembly Visualization
Open modes
| Mode | Loads | Editing |
|---|---|---|
| Resolved | Everything | Full |
| Lightweight | Display and mating data | Mating; resolve to edit features |
| Large Design Review | Graphics data only | View, measure, section; since 2019 insert/move components and mates; since 2020 patterns and mates to reference geometry |
Large Design Review by version
| Version | Change |
|---|---|
| 2012 | Introduced for viewing |
| 2019 | Edit mode: insert and move components, add and edit mates |
| 2020 | Mates to reference geometry, linear and circular patterns |
| 2025 | Interference detection, breadcrumbs, component preview |
Further speed-ups: SpeedPak, subassemblies and the settings in SOLIDWORKS running slow.
Step by step
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1
Find the heavy parts
Open an assembly and go to Evaluate → Assembly Visualization. Change the column from Mass to SW-Rebuild Time and sort — the parts at the top cost most.

Sort by SW-Rebuild Time to see which parts cost most. -
2
Open in Large Design Review
Close it and reopen with File → Open, Mode: Large Design Review. It opens fast; you can view, measure and section. Since 2019 you can also insert and move components and add or edit mates.
-
3
Set components lightweight
In a normal (Resolved) session, right-click components → Set to Lightweight. A feather icon marks them. Set them back to resolved only when you need to edit them.
-
4
Turn on Large Assembly Mode
Tools → Options → System Options → Assemblies: tick Use Large Assembly Mode and set the component count at which it starts.
Common mistakes
- Opening everything resolved out of habit. Use lightweight or LDR when you only need to look.
- Flexible subassemblies in an LDR session — Edit Assembly is unavailable with them.
- Fixing performance with hardware first. Assembly Visualization often shows one or two parts — a modelled thread, an imported mesh — slowing everything down.
Lesson 13 of 16 in the assemblies course.
Practice
Run Assembly Visualization on any assembly you have, sorted by SW-Rebuild Time. Check: note the slowest part, open the assembly in Large Design Review and compare the opening time — LDR should open noticeably faster on large models.
Sources
- Hawk Ridge — File opening modes: resolved, lightweight, LDR
- CATI — Large Design Review
- Javelin — Large Design Review editing (2019)
- GoEngineer — Large Design Review in 2020
- GoEngineer — What's new in SOLIDWORKS 2025 assemblies
- Hawk Ridge — Increase assembly performance
- TriMech — Assembly Visualization to find slow parts
- Javelin — Assembly Visualization performance analysis (2018)
- SOLIDWORKS Tech Blog — Top 10 tips for large assemblies
- CATI — Improving large assembly performance: SOLIDWORKS settings
Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.
Frequently asked questions
What is Large Design Review in SOLIDWORKS?
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An open mode, introduced in SOLIDWORKS 2012, that opens very large assemblies quickly for review. Since 2019 it also allows inserting and moving components and editing mates.
What does lightweight mean?
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A lightweight component loads only part of its data — enough to display and mate it — which saves memory and time. It shows a feather icon.
How do I find which part slows down my assembly?
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Use Assembly Visualization on the Evaluate tab and sort by SW-Rebuild Time. Since 2018 its Performance Analysis also shows open time and graphics triangles.
What is Large Assembly Mode?
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A group of performance settings that SOLIDWORKS turns on automatically when an assembly has more components than the threshold you set.
Related
- SOLIDWORKS SpeedPakHow to create a SpeedPak configuration in SOLIDWORKS to lighten subassemblies: include faces and bodies, use it in the parent, and graphics SpeedPaks.
- SOLIDWORKS subassembliesHow to create subassemblies in SOLIDWORKS from selected components, save virtual ones, make them flexible or dissolve them, and why they speed things up.
- SOLIDWORKS running slow — how to speed it upSpeed up a slow SOLIDWORKS with Performance Evaluation, large assembly settings, lightweight mode, image quality, local files and the right graphics setup.
- SOLIDWORKS system requirements (2025–2027)Official SOLIDWORKS system requirements for 2025–2027 — Windows 11, 16 GB RAM minimum, 32 GB recommended, x86_64 CPU, certified graphics card and an SSD.