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Features · Lesson 12

SOLIDWORKS Cosmetic Thread

A cosmetic thread shows a thread without modelling it. It is a graphic and a set of data — standard, size, length — attached to a round face, so drawings show the correct thread symbol and callout while the model stays light and fast. For almost all mechanical design, cosmetic threads are the right choice; model real threads only when the geometry itself is needed, for example for 3D printing.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Shaft with a shaded cosmetic thread texture and a drawing view with a thread callout

Where to find it

Insert → Annotations → Cosmetic Thread (or the Hole Wizard cosmetic thread option)

Cosmetic vs modelled threads

Cosmetic thread Thread feature / helical sweep
Geometry None — display and data Real helical geometry
Rebuild time Practically none Large — in one reseller test the thread was 96% of a part's rebuild time
Drawing callout Automatic Must be added
3D printing Not printed Printed
Best for Almost all mechanical parts Printed parts, renderings, unusual threads

Since SOLIDWORKS 2019 cosmetic threads use a new architecture; older files can be upgraded through a document option. When you really need geometry, use the Thread feature.

Practise it: add cosmetic threads to the M10 bolt and nut.

Step by step

  1. 1

    Make a shaft

    Extrude a Ø10 circle on the Top Plane 30 mm up.

  2. 2

    Add the cosmetic thread

    Insert → Annotations → Cosmetic Thread. Select the circular edge at the top of the shaft. Choose the standard (ISO), type and size (M10), and the thread length.

    Cosmetic Thread PropertyManager with ISO M10 selected and the top edge of a shaft picked
    Pick the circular edge, then the standard, size and length.
  3. 3

    Show it shaded

    If you see nothing, open Tools → Options → Document Properties → Detailing and turn on Cosmetic threads and Shaded cosmetic threads.

  4. 4

    Check the geometry is unchanged

    Mass Properties shows the same volume as before — the thread is a display, not a cut.

Common mistakes

  • Threads not visible because the Detailing display options are off, or annotations are hidden.
  • Expecting shaded threads in non-shaded drawing views — they only appear in shaded views.
  • Modelling threads for every bolt in a big assembly. Cosmetic threads add no geometry and keep rebuilds fast.
  • Old files with legacy threads — upgrade them only if you understand that it cannot be undone.

Lesson 12 of 18 in the features course.

Practice

Add an M10 cosmetic thread to a Ø10 × 30 mm shaft. Check: volume stays 2,356.19 mm³ before and after — the thread changes the display, not the solid.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

Why are my cosmetic threads not showing?

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Turn on Cosmetic threads and Shaded cosmetic threads in Document Properties → Detailing, make sure annotations are visible, and in drawings use a shaded view or insert them with Model Items.

Do cosmetic threads work on holes?

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Yes. Tapped holes from the Hole Wizard can include a cosmetic thread automatically through the cosmetic thread option.

Do cosmetic threads slow SOLIDWORKS down?

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No. They are graphics, not helical geometry, so they add almost no rebuild time — which is why resellers recommend them for large assemblies.

Where do the thread sizes come from?

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From the same Hole Wizard database, so cosmetic threads and tapped holes use the same standards and sizes.