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Features · Lesson 8

SOLIDWORKS Shell

Shell hollows out a solid and leaves walls of a set thickness. Pick the faces to remove — usually the open top of a box or housing — and type the thickness; SOLIDWORKS offsets every other face inward. It is the quickest way to model enclosures, cups and covers. Faces can have their own thickness, and the walls can grow outward instead of inward.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Enclosure box hollowed with thin walls and an open top

Where to find it

Features tab → Shell (Insert → Features → Shell)

Shell options

Option What it does
Thickness Wall thickness
Faces to Remove Faces that become openings
Shell outward Walls grow outward instead of inward
Multi-thickness Separate thickness for selected faces
Show preview Preview of the result
Solid Body Which body to shell in a multibody part

When a shell does fail, the faces that cause it are shown in a different colour. Plastic enclosures usually also need draft and ribs on their thin walls. Thin walls from surfaces are made with Thicken. Whether a shelled plastic part will mould well can be checked in SOLIDWORKS Plastics.

Practise it: the shelled cup and open box exercises.

Practise it: the phone case, the 3D-printed enclosure and the bottle.

When it fails: shell errors explains the minimum radius of curvature check and other fixes.

Step by step

  1. 1

    Build the box

    Extrude a 100 × 60 mm Center Rectangle on the Top Plane 40 mm up.

  2. 2

    Start Shell

    Features → Shell. Set the thickness to 2 mm.

  3. 3

    Remove the top face

    Click the top face so it appears in Faces to Remove. The preview shows an open box.

    Shell preview of a box with the top face removed and 2 mm walls
    Remove the top face and set a 2 mm wall.
  4. 4

    Confirm

    Click the tick. Check the inside with a section view (heads-up toolbar → Section View) if you shelled without removing any face.

Common mistakes

  • A thickness larger than the smallest inside radius of the part. SOLIDWORKS warns that the thickness exceeds the minimum radius of curvature; check the inside or reduce the thickness.
  • Shelling a part with very thin areas, which creates zero-thickness geometry and fails.
  • Merging extra bodies before shelling, which can leave unwanted ledges inside — shell first, then add bosses.

Lesson 8 of 18 in the features course.

Practice

Shell a 100 × 60 × 40 mm box with 2 mm walls, removing the top face. Check: volume 35,712 mm³ (outer box minus a 96 × 56 × 38 mm cavity).

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I make a hollow part in SOLIDWORKS?

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Use Shell. Pick the face or faces to remove and set the wall thickness. With no face removed, the part becomes a closed hollow solid.

Can different walls have different thicknesses?

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Yes. Add faces to the Multi-thickness section of the Shell PropertyManager and give each its own thickness.

Why does my shell fail?

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Usually because the thickness is larger than a curve or fillet radius inside the part, or because thin areas would collapse to zero thickness. Reduce the thickness or simplify those areas.

What does Shell outward do?

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It adds the wall thickness outside the existing faces instead of inside, so the original shape becomes the inside of the part.