Features · Lesson 6
SOLIDWORKS Fillet
Fillet rounds sharp edges — outside edges become rounded, inside corners get material added. It is an applied feature: you pick edges or faces, set a radius, and SOLIDWORKS does the rest without a sketch. Fillets are best added near the end of the tree, largest radius first, because they remove the sharp edges other features may need.

Where to find it
Features tab → Fillet (Insert → Features → Fillet)
Fillet types
| Type | What it does |
|---|---|
| Constant Size | One radius along the edge; multiple radii and asymmetric fillets possible |
| Variable Size | Radius changes along the edge through control points |
| Face Fillet | Blends two sets of faces, even across a gap |
| Full Round | Rounds a face completely between two side faces — no radius needed |
Fillet profiles
| Profile | Shape |
|---|---|
| Circular | Standard round |
| Conic Rho / Conic Radius | Conic section — flatter or fuller than a circle (since 2014) |
| Curvature Continuous | Smooth transition matching the curvature of the faces (since 2016 for constant and variable fillets) |
Useful options
- Tangent propagation — continues the fillet along tangent edges with one pick.
- Full / Partial / No preview — turn the preview down when filleting dozens of edges.
- Setback — smooths corners where three filleted edges meet.
- Partial edge (since 2019) — fillet only part of an edge.
- FilletXpert tab — add, resize or remove fillets by size and fix corners.
Fillets that fail are covered in rebuild errors. The square-edged version is Chamfer.
Feature order with fillets is practised in the enclosure and fluted knob exercises.
When it fails: see fillet errors for fillet order, FilletXpert and corner fixes.
Step by step
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1
Build a block
Extrude an 80 × 50 mm Center Rectangle on the Top Plane 20 mm up.
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2
Start a constant size fillet
Features → Fillet. Keep Constant Size Fillet and set the radius to 5 mm.
-
3
Pick the edges
Click the four vertical edges of the block. Each appears in the Items to Fillet box with a preview. Picking a face instead would fillet all its edges.

Pick the four vertical edges and set a 5 mm radius. -
4
Confirm
Click the tick. If you want different radii on some edges, tick Multiple radius fillet and set a value per edge.
Common mistakes
- Filleting early in the tree. Later features lose the sharp edges they referenced and fail. Fillet last, largest radius first.
- Too many edges of different sizes in one fillet feature. Group edges of one size per feature.
- A radius too large for the geometry — the preview disappears. As the SOLIDWORKS blog puts it, no preview means no fillet.
- Clearing Keep features — the fillet can swallow a nearby hole or boss.
Lesson 6 of 18 in the features course.
Practice
Fillet the four vertical edges of an 80 × 50 × 20 mm block with R5. Check: volume 79,570.80 mm³ (each R5 corner removes 107.30 mm³).
Sources
- Hawk Ridge — Features basics in SOLIDWORKS
- Hawk Ridge — Exploring fillets in SOLIDWORKS
- Javelin — How to use fillet tools (May 2023)
- GoEngineer — FilletXpert tool tutorial (Jan 2023)
- Javelin — Full round fillets
- GoEngineer — Partial chamfers and fillets explained
- Javelin — How feature ordering affects your design (Jun 2026)
- SOLIDWORKS blog — Basic techniques: learning fillets
- TriMech — Introducing FilletXpert
- TriMech — SOLIDWORKS modelling errors, part two (Jan 2023)
Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.
Frequently asked questions
Why does my fillet fail in SOLIDWORKS?
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Common causes are a radius too large for the neighbouring faces, too many edges in one feature, or a fillet placed before features that change the edges. Try a smaller radius, split the fillet, or move it later in the tree. FeatureXpert can reorder fillets automatically.
What is a full round fillet?
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A fillet with no radius value that rounds a face completely between two side faces, like the end of a rib. Pick side face, centre face and other side face in order.
What is FilletXpert?
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A tab in the Fillet PropertyManager that adds, changes and removes fillets by radius, solves corner fillets and can reorder fillets to avoid errors.
Fillet or chamfer?
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Fillets for strength, handling and moulded parts; chamfers for machined edges, lead-ins and easy deburring. Since 2017 you can convert one into the other.
Related
- SOLIDWORKS ChamferHow to add chamfers in SOLIDWORKS: distance and angle, equal distance, vertex, Offset Face and Face-Face types, partial edges and Keep features.
- SOLIDWORKS ShellHow to use Shell in SOLIDWORKS to hollow a part: faces to remove, wall thickness, shell outward, multi-thickness walls, and what to do when the shell fails.
- SOLIDWORKS rebuild errors and warnings — how to fix themFix SOLIDWORKS rebuild errors: red and yellow feature icons, the What's Wrong dialog, dangling references, zero-thickness geometry and failed fillets.
- Your first SOLIDWORKS part, step by stepModel your first SOLIDWORKS part in 15 minutes: a sketch on the Front Plane, Smart Dimension, Extruded Boss, a hole and fillets, with a check mass.