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Advanced parts · Lesson 2

SOLIDWORKS Circular Pattern

Circular Pattern copies features, faces or bodies around an axis — bolt circles on flanges, spokes, teeth, vents in a round cover. Pick the seed, the axis (an axis, a circular edge or a cylindrical face) and the number of copies; Equal spacing spreads them over 360°. Since SOLIDWORKS 2017 a second direction can pattern the other way, symmetrically or with its own settings.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Flange with six holes on a bolt circle created by a circular pattern around a central axis

Where to find it

Features tab → Linear Pattern flyout → Circular Pattern

Circular Pattern options

Option What it does
Pattern axis Axis, circular edge or cylindrical face; Reverse direction
Equal spacing Sets the total angle to 360°
Angle / instance spacing Angle between instances (when not equal)
Number of instances Copies including the seed
Direction 2 (2017+) Pattern the other way; Symmetric mirrors Direction 1
Instances to Skip Remove individual copies
Instances to Vary Change a seed dimension per copy
Vary sketch Lets the pattern change as it repeats
Geometry pattern Copies faces and edges only — faster
Propagate visual properties Copies colours, textures and cosmetic thread data
Full / Partial preview Full computes every instance; partial shows seed geometry only

From the official Circular Pattern PropertyManager reference. For patterns along curves, from tables or filling an area, see other patterns.

Practise it: the hub flange and disk with hole pattern exercises.

Practise it: pattern the teeth of the spur gear and the arms of the drone frame.

Step by step

  1. 1

    Model the flange

    On the Top Plane sketch a Ø100 circle and a concentric Ø30 circle, and extrude 10 mm — a flange with a centre hole.

  2. 2

    Cut the seed hole

    Cut one Ø10 hole through all, centred 35 mm from the centre on a line from the origin (a Ø70 pitch circle).

  3. 3

    Pattern it around the flange

    Features → Circular Pattern. Pattern axis: the cylindrical face of the centre hole (or its temporary axis). Tick Equal spacing (360°), instances 6, features to pattern: the hole.

    Circular Pattern preview of six holes on a 70 mm pitch circle with equal spacing
    Six instances with Equal spacing around the centre hole.
  4. 4

    Confirm

    Click the tick. Change the instance count to 8 later — all holes rearrange evenly.

Common mistakes

  • Forgetting Equal spacing, so the angle box means the angle between copies, not the total.
  • Counting instances without the seed — the number of instances includes the original.
  • Choosing an axis that will disappear later; a cylindrical face of a feature you may delete breaks the pattern.

Lesson 2 of 16 in the advanced parts course.

Practice

Build the Ø100 × 10 mm flange with a Ø30 centre hole and six Ø10 holes on a Ø70 pitch circle. Check: volume 66,758.84 mm³.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

What can I use as the axis of a circular pattern?

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A reference axis, a temporary axis, a circular edge or a cylindrical face. Show temporary axes from the heads-up toolbar to pick them easily.

How do I space instances evenly around 360°?

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Tick Equal spacing — it sets the angle to 360° and spreads the instances evenly.

Can a circular pattern go in both directions?

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Yes, since SOLIDWORKS 2017. Direction 2 can be symmetric to Direction 1 or have its own angle and count.

How do I pattern a hole on a bolt circle?

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Make one hole at the pitch radius, then circular-pattern it around the centre axis with Equal spacing and the number of bolts.