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Project 1

How to make a spur gear in SOLIDWORKS

A spur gear is the classic first mechanical project. SOLIDWORKS offers two routes: drag a Toolbox gear in seconds, or model a true involute tooth with an equation-driven curve. The Toolbox tooth is a circular-arc approximation — fine for assemblies, BOMs and motion, not for cutting the gear from the model. This project builds a module 2, 24-tooth gear the accurate way and shows where Toolbox fits.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
3D render of the spur gear from the SOLID WORKS Club project
Level
Project
Time
45 min
Material
Mild steel, 7.85 g/cm³
Check mass
199.80 g

Specification

Parameter Value
Module m 2 mm
Teeth z 24
Pressure angle 20°
Pitch diameter d = m·z 48 mm
Tip diameter m(z + 2) 52 mm
Root diameter m(z − 2.5) 43 mm
Base circle d·cos 20° 45.11 mm
Face width / bore 15 mm / Ø10

The drawing

Dimensioned drawing of the spur gear project with orthographic and isometric views
Dimensions in mm, third-angle projection. Download the PDF to print it.

Step by step

1. Sketch the circles

On the Front plane draw construction circles for the pitch (Ø48), base (Ø45.11), tip (Ø52) and root (Ø43) diameters. Drive them from global variables m and z so the gear can be resized.

2. Draw one involute flank

Use an equation-driven curve with the parametric option for the involute, from the base circle out to the tip circle. Sketch only half a tooth and mirror it — this keeps rebuilds fast.

3. Close the tooth

Join the flanks with an arc on the tip circle, add radial lines down to the root circle, and mirror about the tooth centreline. Tooth thickness at the pitch circle is πm/2 = 3.14 mm.

4. Extrude and pattern

Extrude the gear blank (root circle) 15 mm, add the tooth, then Circular Pattern 24 instances. Cut the Ø10 bore.

5. Or use Toolbox

For an assembly or BOM, open Design Library → Toolbox → ISO → Power Transmission → Gears and drag a Spur Gear in; set module 2, 24 teeth, 20°, face width 15 and the bore in the PropertyManager.

Check your result

  • Measure the tip diameter: Ø52.
  • Measure across the root: Ø43.
  • The pitch circle Ø48 should cut each tooth where its thickness is 3.14 mm.
  • Our STEP model (true involute) weighs 199.80 g in mild steel at 7.85 g/cm³ — a Toolbox gear will differ slightly because its teeth are arcs.

Compare your model with the STEP file above — it opens in SOLIDWORKS and most other CAD programs.

Next: project 2 — helical gear.

Download files

Commands used

Show solution
  1. Sketch the circles. On the Front plane draw construction circles for the pitch (Ø48), base (Ø45.11), tip (Ø52) and root (Ø43) diameters. Drive them from global variables m and z so the gear can be resized.
  2. Draw one involute flank. Use an equation-driven curve with the parametric option for the involute, from the base circle out to the tip circle. Sketch only half a tooth and mirror it — this keeps rebuilds fast.
  3. Close the tooth. Join the flanks with an arc on the tip circle, add radial lines down to the root circle, and mirror about the tooth centreline. Tooth thickness at the pitch circle is πm/2 = 3.14 mm.
  4. Extrude and pattern. Extrude the gear blank (root circle) 15 mm, add the tooth, then Circular Pattern 24 instances. Cut the Ø10 bore.
  5. Or use Toolbox. For an assembly or BOM, open Design Library → Toolbox → ISO → Power Transmission → Gears and drag a Spur Gear in; set module 2, 24 teeth, 20°, face width 15 and the bore in the PropertyManager.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

Is the SOLIDWORKS Toolbox gear a true involute?

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No. Hawk Ridge explains that the Toolbox spur gear tooth is a constant-radius arc — good for assemblies, BOMs and basic motion, not for stress analysis or manufacturing straight from CAD.

What is the pitch diameter of a gear?

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Module times number of teeth: d = m·z. A module 2, 24-tooth gear has a 48 mm pitch diameter.