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SOLID WORKS ClubSOLID WORKS Club

Sketching · Lesson 16

Linear and circular sketch patterns

Sketch patterns copy sketch entities in rows (linear) or around a centre (circular) inside one sketch. They are handy for small numbers of repeated shapes, such as a row of slots or holes on a bolt circle. For large numbers, feature patterns are much faster to rebuild — in one reseller test, a sketch pattern of 841 holes took about 18 times longer than the equivalent geometry pattern.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Linear grid of holes and a circular bolt pattern sketched with pattern arrows

Where to find it

Sketch tab → Linear Sketch Pattern flyout (Linear, Circular)

Circular sketch pattern options

Option What it does
Center X / Y Pattern centre — drag the point or snap it to a circle centre
Spacing Total angle covered, e.g. 360°
Equal spacing Spreads instances evenly over the angle
Number of instances Including the original
Dimension radius / angular spacing Adds those as dimensions
Radius / Arc angle Distance and angle of the seed from the centre
Reverse direction Clockwise or counter-clockwise

Linear patterns set instances, spacing and direction for one or two directions in the same way.

Sketch pattern or feature pattern?

Case Better choice
A few repeated shapes in one outline Sketch pattern
Holes or bosses repeated many times Feature pattern
Pattern that differs by configuration Feature pattern
Very large hole grids Feature pattern with the Geometry option, or cosmetic patterns

Feature patterns are covered in the upcoming features course. A slow part with many patterns? See SOLIDWORKS running slow.

Feature patterns are covered in Linear Pattern and Circular Pattern.

Step by step

  1. 1

    Sketch the plate and the first hole

    On the Front Plane draw a Corner Rectangle 100 × 60 from the origin. Add a Circle Ø10 whose centre is 20 mm from the left edge and 15 mm from the bottom edge.

  2. 2

    Linear pattern

    Click Linear Sketch Pattern, select the circle. Direction 1: 3 instances, spacing 30 mm along X. Direction 2: 2 instances, spacing 30 mm along Y. Click the tick.

    Linear sketch pattern of a 10 mm circle in 3 by 2 instances at 30 mm spacing on a plate
    One seed circle, 3 × 2 instances at 30 mm spacing.
  3. 3

    Extrude

    Exit the sketch and extrude it 10 mm — the six circles become six through holes.

  4. 4

    Edit the pattern later

    Edit the sketch, right-click one of the pattern instances → Edit Linear Pattern to change the count or spacing.

Common mistakes

  • Patterning dozens of holes in a sketch. Model one hole as a feature and use a feature pattern — it rebuilds far faster.
  • Forgetting to dimension the seed entity's position; the pattern moves with it.
  • Choosing a spacing that pushes instances outside the outline — the extrude then fails or gives unexpected shapes.

Lesson 16 of 17 in the sketching course.

Practice

Build the plate above: 100 × 60 mm, six Ø10 holes in a 3 × 2 linear sketch pattern at 30 mm pitch, starting 20 mm from the left and 15 mm from the bottom, extruded 10 mm. Check: volume 55,287.61 mm³.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

What is the difference between a sketch pattern and a feature pattern?

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A sketch pattern copies entities inside one sketch. A feature pattern copies whole features (holes, bosses) in the part. Feature patterns have more options and usually rebuild faster.

How do I make a bolt circle in a sketch?

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Draw one circle, then use Circular Sketch Pattern around the centre point with the number of instances and 360° total angle, with Equal spacing ticked.

How do I edit a sketch pattern?

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Edit the sketch, right-click a patterned entity or the seed, and choose Edit Linear Pattern or Edit Circular Pattern.

Why is my part slow with many holes?

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Sketch patterns make SOLIDWORKS solve many relations. Feature patterns, especially with the Geometry pattern option, or cosmetic patterns, are much faster.