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Advanced parts · Lesson 10

SOLIDWORKS multibody parts

A multibody part is one part file that holds two or more separate solid bodies. Bodies appear in the Solid Bodies folder at the top of the tree. They let you design several pieces that depend on each other in one place — a mould and its core, a frame and its panels — without managing assembly references. When the design settles, Save Bodies turns them into separate part files and an assembly.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Part with several solid bodies in different colours and a Solid Bodies folder listing them

Where to find it

FeatureManager → Solid Bodies folder; feature options Merge result and Feature Scope

Multibody part or assembly?

Multibody part Assembly
Pieces live in One file Separate part files
References between pieces Easy — same file In-context references
Movement / mates None — static Mates and motion
BOM Cut lists (weldments) Full BOM
Scale Few related pieces Any size
Typical use Moulds, weldments, master models Products, machines

Ways to bring bodies in or out

  • Save Bodies — bodies to part files plus an assembly.
  • Insert into New Part — right-click one body to make a derived part from it.
  • Insert → Part — bring another part in as a body (master modelling); position it with Move/Copy Bodies.
  • Make Multibody Part — the reverse: an assembly turned into one multibody part linked to it.

Working with bodies continues in Split and Combine. Two whole courses build on multibody parts: weldments and surfacing.

Step by step

  1. 1

    Make two bodies from one sketch

    On the Front Plane sketch two separate 40 × 30 mm rectangles 20 mm apart and extrude 10 mm. Because the sketch has two closed regions that do not touch, you get two bodies — look at Solid Bodies (2).

  2. 2

    Add a body that stays separate

    Sketch a 20 × 20 mm square on top of one block and extrude it 10 mm with Merge result unticked. It becomes a third body even though it touches the block.

    Extrude PropertyManager with Merge result unchecked creating a separate body on top of a block
    Untick Merge result and the new extrude stays a separate body.
  3. 3

    Target one body with Feature Scope

    Add a fillet or cut and open Feature Scope: choose Selected bodies, untick Auto-select and pick only the body you want to change.

  4. 4

    Turn bodies into parts

    Rename the bodies (select, F2), right-click Solid Bodies → Save Bodies, tick the bodies, set a file name for each, and under Create Assembly browse to a new assembly name. SOLIDWORKS writes linked part files and an assembly.

Common mistakes

  • Merge result left on, so a new feature fuses with a body you wanted to keep separate.
  • Adding features after the Save Bodies feature and expecting them in the saved parts — only changes above it propagate.
  • Using a multibody part where you need a BOM, motion or many parts. An assembly is the right tool there.
  • Mirroring or patterning without picking bodies in Bodies to Mirror/Pattern, so features are copied instead of whole bodies.

Lesson 10 of 16 in the advanced parts course.

Practice

Create the two 40 × 30 × 10 mm blocks from one sketch and the separate 20 × 20 × 10 mm body. Check: Solid Bodies shows 3, and Mass Properties for the whole part reads 28,000 mm³ (24,000 + 4,000).

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

What is a multibody part in SOLIDWORKS?

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A part file containing two or more solid bodies, listed in the Solid Bodies folder. Each body could be a separate physical piece.

How do I keep a new feature as a separate body?

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Untick Merge result in the feature's PropertyManager. The new feature then becomes its own body even if it touches existing ones.

How do I turn a multibody part into an assembly?

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Use Save Bodies (right-click the Solid Bodies folder), choose the bodies and file names, and fill in Create Assembly. The new parts are linked to the master part.

Should I use a multibody part or an assembly?

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Multibody parts suit tightly related geometry designed together — moulds, weldments, master models. Use an assembly when you need a BOM, motion, many parts or different people working on parts.