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Advanced parts · Lesson 11

Split, Combine and Intersect in SOLIDWORKS

These tools work on whole bodies. Split cuts a body into pieces with a plane, surface or sketch. Combine joins bodies (Add), removes one from another (Subtract) or keeps only their overlap (Common). Intersect, available since 2013, builds solids from the regions where bodies, surfaces and planes cross. Delete/Keep Body removes bodies you no longer need.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Three diagrams of Combine Add, Subtract and Common on a block and a cylinder

Where to find it

Insert → Features → Split / Combine / Intersect

Body tools at a glance

Tool What it does
Split Cuts bodies with planes, surfaces or sketches; pieces can be saved as files
Combine – Add Merges bodies into one
Combine – Subtract Removes tool bodies from a main body
Combine – Common Keeps only the shared volume
Intersect (2013+) Builds or removes regions where solids, surfaces and planes cross
Delete/Keep Body Deletes bodies, or keeps only the selected ones (2015+)

Split trim tools

Tool Extends?
Plane, planar face, sketch Extends infinitely
Surface body, non-planar face No — must cross the whole body

Typical uses: tool bodies for cuts, plastic housings split into halves, and mould tooling.

Practise it: subtract the phone body in the phone case project.

Step by step

  1. 1

    Make a block and a tool body

    Extrude a 60 × 40 mm Center Rectangle on the Top Plane 20 mm. Then sketch a Ø20 circle on the top face, centred, and extrude it 20 mm down into the block with Merge result unticked — a separate cylinder body.

  2. 2

    Subtract

    Insert → Features → Combine, type Subtract. Main Body = the block, Bodies to Subtract = the cylinder. Click the tick — the cylinder is removed and leaves a hole.

    Combine Subtract with the block as main body and the cylinder as body to subtract
    The main body stays; the tool body is removed from it.
  3. 3

    Split a body in two

    In a new part, extrude a 100 × 50 × 20 mm block. Insert → Features → Split, trim tool = the Right Plane, click Cut Bodies, tick both resulting bodies and confirm.

Common mistakes

  • Thinking an unticked body in Split is deleted. Unticked pieces fuse back where they can; use Consume cut bodies to delete.
  • Picking the bodies in the wrong boxes in Subtract — the main body is what remains.
  • Pieces that touch only at an edge after Split cannot merge, so you get more bodies than expected.

Lesson 11 of 16 in the advanced parts course.

Practice

Subtract the Ø20 × 20 cylinder body from the 60 × 40 × 20 mm block. Check: volume 41,716.81 mm³, one body. Split the 100 × 50 × 20 block with the Right Plane: two bodies of 50,000 mm³ each.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

What does Combine do in SOLIDWORKS?

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It combines solid bodies in a multibody part: Add merges them, Subtract removes the tool bodies from a main body, and Common keeps only the volume they share.

How do I cut a part into two pieces?

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Use Insert → Features → Split with a plane, surface or sketch as the trim tool, click Cut Bodies, and tick the pieces to keep as bodies. You can also save them as separate part files.

What is the Intersect feature?

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A feature added in SOLIDWORKS 2013 that intersects solids, surfaces and planes and lets you choose which regions to keep — for example to make a solid from the space inside a closed set of surfaces.

How do I delete a body?

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Use Delete/Keep Body and choose whether to delete the selected bodies or keep only them (the Keep option arrived in 2015).