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SOLID WORKS ClubSOLID WORKS Club

Advanced parts · Lesson 4

SOLIDWORKS Mirror and Mirror Part

Mirror copies features, faces or whole bodies to the other side of a plane or planar face, so you model half of a symmetric part and let SOLIDWORKS make the rest. Since SOLIDWORKS 2022 a secondary mirror plane can mirror in two directions at once. For left- and right-hand versions of a part, Mirror Part creates a new, linked opposite-hand part file.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Half of a symmetric part mirrored across a plane and a separate opposite-hand bracket

Where to find it

Features tab → Linear Pattern flyout → Mirror; Insert → Mirror Part

Mirror feature vs Mirror Part

Mirror feature Mirror Part
Result Symmetric geometry in the same part New opposite-hand part file
Link Feature in the tree Derived part linked to the original
Transfers — Bodies, Hole Wizard data, sheet metal info, material, custom properties, sketches
Since — Material and appearance carry-over since 2018

Mirror inside a sketch is covered in Mirror Entities.

Mirroring components in an assembly: Mirror Components.

Step by step

  1. 1

    Model one half

    On the Front Plane sketch a 40 × 30 mm Corner Rectangle that starts on the origin and goes to the right, and extrude it 10 mm. Its left face lies on the Right Plane.

  2. 2

    Mirror the body

    Features → Mirror. Mirror Face/Plane: the Right Plane. Under Bodies to Mirror pick the block, and tick Merge solids so the halves join.

    Mirror PropertyManager with Right Plane as mirror plane and the block as body to mirror
    Mirror the whole body across the Right Plane and merge the halves.
  3. 3

    Make an opposite-hand part

    Save the part. Select the Right Plane first, then Insert → Mirror Part. Choose what to transfer (bodies, material, Hole Wizard data), confirm, and save the new part — it is linked to the original.

Common mistakes

  • Merge solids ticked when the halves do not touch — there is nothing to merge.
  • Forgetting to pick the plane before Insert → Mirror Part, so the command is greyed out.
  • Breaking the link of a mirror part — it cannot be restored.
  • Mirroring features one by one when the whole body is symmetric. Mirror the body.

Lesson 4 of 16 in the advanced parts course.

Practice

Mirror the 40 × 30 × 10 mm half block about the Right Plane with Merge solids. Check: one body of 24,000 mm³, centred on the Right Plane.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I mirror a part in SOLIDWORKS?

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To mirror geometry within the part, use the Mirror feature with a plane and the features or bodies to mirror. To make a separate opposite-hand part, select a plane and use Insert → Mirror Part.

What does Merge solids do?

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It joins the mirrored body to the original when they touch, giving one body instead of two.

Does a mirrored part update when the original changes?

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Yes, Mirror Part creates a derived part linked to the original. Breaking the link makes it independent, and that cannot be undone.

Can I mirror in two directions at once?

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Yes, since SOLIDWORKS 2022 the Mirror feature has a secondary mirror plane, so one feature can make four copies.