Assemblies · Lesson 15
Component patterns and Mirror Components
Component patterns place copies of parts in an assembly without mating each one. Linear and circular component patterns work like their feature versions. Pattern Driven Component Pattern reuses a pattern that already exists in a part — four bolts follow the four holes. Chain patterns, added in 2015, place links along a path, and Mirror Components copies parts to the other side of a plane, including opposite-hand versions.

Where to find it
Assembly tab → Linear Component Pattern flyout
Component pattern types
| Type | Places copies |
|---|---|
| Linear Component Pattern | In rows along one or two directions |
| Circular Component Pattern | Around an axis |
| Pattern Driven Component Pattern | Following a feature pattern in a part |
| Chain Component Pattern (2015+) | Along an open or closed path |
| Mirror Components | Across a plane; same part, or an opposite-hand version |
Since 2020 individual instances of linear and circular component patterns can be edited, Pattern Driven patterns understand Hole Wizard orientation from 3D sketches, and Mirror Components can align by component origins. Feature patterns inside parts are covered in Linear Pattern.
Practise it: pattern the seven balls of the 6201 ball bearing.
Step by step
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1
Pattern the holes in the part
Edit the plate so it has four Ø10 holes made by a linear pattern (2 × 2) of one seed hole.
-
2
Mate one pin
Mate a single pin into the seed hole (concentric + coincident).
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3
Pattern Driven Component Pattern
Linear Component Pattern flyout → Pattern Driven Component Pattern. Components to pattern: the pin. Driving feature: the plate's hole pattern. The seed is picked automatically.

One mated pin follows the hole pattern in the plate. -
4
Change the part pattern
Edit the plate and change the hole pattern to 3 × 2. Rebuild the assembly — six pins appear in the holes.
Common mistakes
- Mating every copy by hand. Pattern the component instead — one feature, easy to change.
- Driving a component pattern from a sketch pattern in the part when a feature pattern exists — use the feature pattern.
- Mirroring a non-symmetric part as a plain copy when it needs an opposite-hand version. Check the symmetry first; opposite-hand parts are new files and change the BOM.
Lesson 15 of 16 in the assemblies course.
Practice
Drive a pin pattern from a 2 × 2 hole pattern in the 100 × 60 × 10 mm plate. Check: the assembly volume is 66,283.19 mm³ (plate with four holes plus four pins), and a BOM lists pin × 4.
Sources
- Javelin — SOLIDWORKS 2020 assembly pattern enhancements
- TriMech — Linear component patterns
- TriMech — Pattern driven component pattern
- Javelin — Chain component pattern (2015)
- GoEngineer — Assembly mirroring for in-context parts (Dec 2025)
Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.
Frequently asked questions
How do I pattern a part in an assembly?
+
Use Linear or Circular Component Pattern on the Assembly tab, or Pattern Driven Component Pattern to follow a pattern feature in another part.
What is a pattern driven component pattern?
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A component pattern that reuses a feature pattern from a part, so the components follow the holes or features — and update when that pattern changes.
What is a chain component pattern?
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A pattern, added in SOLIDWORKS 2015, that places components such as chain links along an open or closed path.
How do I make an opposite-hand part in an assembly?
+
Use Mirror Components and choose the option to create an opposite-hand version. It creates a new part file, which also appears in the BOM.
Related
- SOLIDWORKS Linear PatternHow to use Linear Pattern in SOLIDWORKS: one or two directions, spacing, Up to reference, skipping and varying instances, and Geometry pattern.
- SOLIDWORKS bill of materials (BOM)How to create a bill of materials in SOLIDWORKS: top-level, parts-only and indented BOMs, part numbers, custom columns, sorting, templates and balloons.
- SOLIDWORKS Mirror and Mirror PartHow to mirror features, faces and bodies in SOLIDWORKS across a plane, use a secondary mirror plane, and create opposite-hand parts with Insert Mirror Part.
- Toolbox fasteners in assembliesHow to add bolts, nuts and washers to SOLIDWORKS assemblies with Toolbox: drag onto holes, change sizes, Smart Fasteners and configuration settings.