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SOLID WORKS ClubSOLID WORKS Club

Sketching · Lesson 5

SOLIDWORKS slot tools

A slot is two parallel lines joined by two half-circles — the shape of a milled slot or an adjustment hole. The Slot tool draws it in one go and keeps it a slot: the ends stay tangent and the width stays equal. There are four types: two straight and two curved. Tick Add dimensions and SOLIDWORKS adds the width and either the centre-to-centre or the overall length for you.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Four slot types — straight, centerpoint straight, three point arc and centerpoint arc — sketched side by side

Where to find it

Sketch tab → Slot flyout

The four slot types

Type Starts from Use
Straight Slot One end Slots positioned from an end
Centerpoint Straight Slot The centre Slots centred on a point or the origin
3 Point Arc Slot Three points on the arc Curved slots through known points
Centerpoint Arc Slot The arc centre Curved slots around a pivot hole

With Add dimensions ticked, SOLIDWORKS dimensions the slot as Center to Center or Overall Length — choose the one your drawing needs. To keep several slots identical, use the Equal Slots relation from sketch relations.

Practise it: the slotted plate and link arm exercises.

Step by step

  1. 1

    Choose Centerpoint Straight Slot

    On the Front Plane pick Slot → Centerpoint Straight Slot — it grows from the middle, so you can centre it on the origin.

  2. 2

    Set the dimension options

    In the PropertyManager tick Add dimensions and choose Center to Center for the length type.

  3. 3

    Draw it

    Click the origin (centre), click to the right for the length, then move up or down and click for the width.

    Centerpoint straight slot 50 mm centre to centre and 16 mm wide on the origin with dimensions
    Centerpoint Straight Slot with dimensions added automatically.
  4. 4

    Edit the values

    Double-click the length dimension → 50, the width → 16. The slot is fully defined once its centre is on the origin and it is horizontal.

Common mistakes

  • Dimensioning between the two arcs with Smart Dimension gives centre-to-centre, not the overall length. Use Add dimensions → Overall Length, or Shift-click the arcs.
  • Drawing a slot from lines and arcs by hand. It works, but the Slot tool keeps tangency and equal radii for you.
  • Forgetting the slot needs an orientation — a horizontal or vertical relation, or an angle.

Lesson 5 of 17 in the sketching course.

Practice

Draw a Centerpoint Straight Slot on the origin, 50 mm centre-to-centre and 16 mm wide, and extrude it 10 mm. Check: volume 10,010.62 mm³ (a 50 × 16 rectangle plus a Ø16 circle, times 10 mm).

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I dimension the overall length of a slot?

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Choose Overall Length in the Slot PropertyManager when Add dimensions is ticked, or hold Shift while clicking the two end arcs with Smart Dimension so the dimension goes to their outer edges.

What is the difference between a straight slot and a centerpoint straight slot?

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A straight slot starts from one end; a centerpoint straight slot starts from its middle. Use the centerpoint type for slots centred on a point.

How do I make an arc-shaped slot?

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Use 3 Point Arc Slot or Centerpoint Arc Slot. They follow an arc, for example for an adjustable angle bracket.

Can I make several slots the same size?

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Yes. Select the slots and add an Equal Slots relation; changing one changes the others.