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Sketching · Lesson 6

SOLIDWORKS polygon tool (hexagons and more)

The Polygon tool draws regular polygons — all sides equal — with 3 to 40 sides. It is the quick way to sketch hexagons for nuts and bolt heads. You size the polygon with a circle that either passes through its corners (inscribed) or touches its flat sides (circumscribed), so you can enter an across-corners or an across-flats size. A polygon also needs a rotation to be fully defined.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Hexagon sketch with inscribed and circumscribed construction circles next to a hex nut

Where to find it

Sketch tab → Polygon

Polygon options

Option What it does
Number of Sides 3 to 40
Inscribed / Circumscribed circle Corners on the circle, or flats touching it
Center X / Y Centre position
Diameter Size of the construction circle
Angle Rotation of the polygon
New Polygon Start another polygon with the same tool

For standard hex nuts and bolts you rarely need to draw them — the Toolbox library inserts them. Draw your own polygons for custom heads, sockets and decorative shapes.

Practise it: the hex spacer exercise.

Practise it: the hexagon of the M10 bolt and nut.

Step by step

  1. 1

    Choose Polygon and set the sides

    Open a sketch on the Front Plane and click Polygon. In the PropertyManager set Number of Sides to 6.

  2. 2

    Pick the circle type

    Inscribed circle (the default) passes through the corners — its diameter is the across-corners size. Circumscribed circle touches the flats — its diameter is the across-flats size, which is how wrench sizes are given.

  3. 3

    Draw it on the origin

    Click the origin for the centre and drag or click outward. Then dimension the construction circle 40 (or type Diameter in the PropertyManager).

    Hexagon on the origin with an inscribed construction circle of 40 mm and a horizontal top side
    A hexagon in an inscribed Ø40 circle, rotated by a horizontal relation.
  4. 4

    Fix the rotation

    The hexagon can still spin around its centre. Make one side Horizontal (select it, then Horizontal in the context toolbar) or set the Angle value. Now it turns black.

Common mistakes

  • Mixing up across corners and across flats. Inscribed = corners, circumscribed = flats.
  • Leaving the rotation free — the sketch stays blue.
  • Drawing a hexagon from six lines. The Polygon tool keeps all sides equal for you.

Lesson 6 of 17 in the sketching course.

Practice

Sketch a hexagon on the origin with an inscribed circle of Ø40 and one side horizontal, and extrude it 10 mm. Check: volume 10,392.30 mm³; the across-flats distance is 34.64 mm (measure it with a dimension between two opposite sides).

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I draw a hexagon in SOLIDWORKS?

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Use the Polygon tool with 6 sides. Click the centre, drag outward, then dimension the construction circle and make one side horizontal.

How many sides can a SOLIDWORKS polygon have?

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Between 3 and 40.

What is the difference between inscribed and circumscribed?

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With an inscribed circle the polygon's corners lie on the circle, so its diameter is the across-corners size. With a circumscribed circle the circle touches the flat sides, so its diameter is the across-flats size.

How do I size a hexagon across flats?

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Choose Circumscribed circle and dimension the circle to the across-flats size, or dimension between two opposite sides directly.