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Sheet metal · Lesson 11

Convert to Sheet Metal and Insert Bends

Not every sheet metal part starts as a base flange. Convert to Sheet Metal turns a solid — your own or an imported STEP file — into sheet metal by picking a fixed face and the edges to bend; SOLIDWORKS adds the rips. Insert Bends does the same for shelled bodies with uniform walls, and Rip opens closed corners so the part can unfold.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Shelled solid box converted to sheet metal with bend edges and rip edges, and its cross-shaped flat pattern

Where to find it

Sheet Metal tab → Convert to Sheet Metal; Insert Bends; Rip

Options

Option Use
Fixed entity Face that stays put when flattening
Bend edges / Collect all bends Edges that become bends
Rip edges Found automatically; gap set per rip
Rip sketch Linear sketch where an edge cannot bend
Reverse thickness Material inside or outside the solid
Keep body Keeps the original solid (multibody parts)
Show callouts Double-click a callout to change one gap or radius
Corner defaults Open butt, overlap or underlap

Insert Bends and Rip

Insert Bends works on shelled or imported bodies with uniform walls: cylindrical faces become rolled bends, sharp edges become bends with your radius, and rips can be added in the same command. Rip cuts a gap along an edge before Insert Bends. Shell is the usual way to make the starting body. For imported files, see STEP files.

Step by step

  1. 1

    Model a simple solid

    Sketch a 100 × 60 rectangle and extrude it 30 mm. Shell it 2 mm, removing the top face — an open box with sharp inside corners.

  2. 2

    Start Convert to Sheet Metal

    Convert to Sheet Metal. Enter thickness 2 and bend radius 2. Pick the bottom face as the fixed entity.

    Convert to Sheet Metal PropertyManager with fixed face, thickness, bend radius and bend edges
    Pick a fixed face and the bend edges; rips are added automatically.
  3. 3

    Pick the bend edges

    Pick the four bottom edges, starting next to the fixed face. The four vertical corners become rip edges automatically. Check the callouts and click the tick.

  4. 4

    Flatten

    Flatten: the box opens into a cross-shaped blank. The tree now has a Sheet-Metal folder, a Convert-Solid feature and a Flat-Pattern.

Common mistakes

  • A badly chosen fixed face — it decides how the flat pattern lies.
  • Picking bend edges in random order — start next to the fixed face so rips fill correctly.
  • Imported IGES parts that refuse to unfold — import STEP or Parasolid and run Import Diagnostics first.
  • Rips on filleted or curved edges — rips work best on straight edges.

Lesson 11 of 13 in the sheet metal course.

Practice

Convert the shelled 100 × 60 × 30 box with four bend edges. Check: the cut list shows Bends: 4 and Sheet Metal Thickness: 2, and Flatten gives one cross-shaped blank with four rips at the corners.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I convert a solid to sheet metal in SOLIDWORKS?

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Use Convert to Sheet Metal on the Sheet Metal tab: set thickness and radius, pick a fixed face and the bend edges; rip edges are added automatically.

What is the difference between Convert to Sheet Metal and Insert Bends?

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Convert to Sheet Metal sets its own thickness from your input. Insert Bends takes the thickness from a shelled or imported body with uniform walls.

How do I flatten an imported STEP part?

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Import with diagnostics and heal the faces, then use Convert to Sheet Metal or Insert Bends. STEP and Parasolid work better than IGES.

How do I flatten a cylinder or cone?

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Since SOLIDWORKS 2024, the Rip feature can cut the gap a cylinder or cone needs; then use Insert Bends.