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Features · Lesson 4

SOLIDWORKS reference planes

A part starts with three planes — Front, Top and Right — but many features need a sketch somewhere else: at a height above the base, at an angle, tangent to a round face, or square to a path. Reference planes give you those sketch surfaces. You define a plane by up to three references (faces, edges, points or other planes) and a constraint such as offset, angle or tangent, until the PropertyManager says Fully Defined.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Part with several reference planes — offset, angled and tangent to a cylinder

Where to find it

Features tab → Reference Geometry → Plane (Insert → Reference Geometry → Plane)

Common ways to define a plane

Plane you need References Constraint
Parallel at a distance A plane or face Offset distance (set number of planes for several)
At an angle A plane or face + an edge or axis Angle
Between two faces Two faces (need not be parallel) Mid Plane
Tangent to a round face A cylinder + a plane (or two cylinders) Tangent, with an angle to rotate it
Through three points Three points or vertices Coincident
Perpendicular to a line An edge or sketch line + a point on it Perpendicular
Facing the screen A point Parallel to screen

A shortcut for sweep profiles: select an edge near its end and click Sketch — SOLIDWORKS creates a plane normal to the edge and starts a sketch on it. Since SOLIDWORKS 2025 planes can also be patterned linearly or circularly.

Tangent planes are also how you place text for Wrap. Planes are the backbone of lofts and sweeps; axes are covered in the next lesson.

Step by step

  1. 1

    Build a base block

    Extrude a 60 × 60 mm Center Rectangle on the Top Plane, 20 mm up.

  2. 2

    Create an offset plane

    Reference Geometry → Plane. As First Reference pick the Top Plane in the flyout tree, choose Offset distance and type 30 mm (flip if it goes down). The message Fully Defined appears; click the tick.

    Offset plane 30 mm above the Top Plane with the Plane PropertyManager showing Fully Defined
    An offset plane is defined by one reference and a distance.
  3. 3

    Sketch on the new plane

    Select Plane1, start a sketch and draw a Ø20 circle on the origin.

  4. 4

    Extrude down to the block

    Extruded Boss/Base, reverse the direction so it points down, and choose Up To Surface → the top face of the block. The cylinder fills the 10 mm gap exactly — and follows if the plane or block moves.

Common mistakes

  • Creating a plane that is not fully defined — check the message in the PropertyManager before clicking OK.
  • Making a new plane for every offset sketch. Extrude's From option can start at an offset without a plane.
  • Building planes on faces that will later change (fillets, cuts). Reference the default planes or stable faces where possible.

Lesson 4 of 18 in the features course.

Practice

Build the block with the plane 30 mm above the Top Plane and the Ø20 cylinder extruded down to the block. Check: total volume 75,141.59 mm³. Change the plane offset to 40 — the cylinder should grow to 20 mm.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I create a plane at an angle in SOLIDWORKS?

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Pick a plane or face as the first reference and an edge or axis as the second, then choose the angle option and type the angle. The plane rotates about the edge or axis.

How do I make a plane tangent to a cylinder?

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Pick the cylindrical face and a plane, then set an angle to rotate the tangent plane around the cylinder. Picking two cylinders gives a plane tangent to both.

How do I create several parallel planes at once?

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In the Plane PropertyManager set the number of planes after the offset distance; SOLIDWORKS creates them evenly spaced.

What is the quickest way to make an offset plane?

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Hold Ctrl and drag an existing plane in the graphics area, then type the offset distance.