Skip to content
SOLID WORKS ClubSOLID WORKS Club

Features · Lesson 15

SOLIDWORKS Loft

Loft blends between two or more profiles on different planes — a square base into a round top, a nozzle, a duct transition. Each profile is a closed sketch (or a face). SOLIDWORKS connects them in the order you pick. Guide curves and start/end constraints control the shape in between, and connectors fix lofts that come out twisted.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Square profile blended into a round profile on an offset plane by a loft

Where to find it

Features tab → Lofted Boss/Base; Lofted Cut

Loft options

Option What it does
Profiles Two or more closed sketches, faces or edges; order with the arrows
Start/End Constraints Shape at the first and last profile, e.g. Normal to Profile
Guide Curves Splines or lines touching each profile that steer the shape
Centerline Parameters A centerline the loft follows between profiles
Connectors Which points of the profiles are joined — fixes twisting
Thin Feature Hollow loft with a wall thickness

For smooth, high-quality shapes controlled in two directions, use Boundary.

Practise it: the lofted hopper exercise.

When it twists or fails: sweep and loft errors shows how to line up connectors and profiles.

Step by step

  1. 1

    Create the two sketches

    On the Top Plane sketch a 40 × 40 Center Rectangle. Create a plane 50 mm above the Top Plane and sketch a 20 × 20 Center Rectangle on it.

  2. 2

    Start the loft

    Features → Lofted Boss/Base. In Profiles pick the two sketches — click each near the same corner, because the pick points become the connectors.

    Two square profiles on parallel planes with matching green connectors and a loft preview
    Pick both profiles near the same corner so the connectors line up.
  3. 3

    Check the preview

    The preview shows a tapered block. If it looks twisted, drag the green connector dots to matching corners, or right-click → Reset connectors and pick again.

  4. 4

    Confirm

    Click the tick. Add constraints such as Normal to Profile at the start or end only if you need a curved transition.

Common mistakes

  • Picking profiles at different corners, which twists the loft.
  • Non-planar sketches as profiles — loft profiles must be planar (Boundary can use non-planar curves).
  • Expecting tangency in the middle of a loft — loft controls tangency only at the first and last profiles.
  • Open profiles for a solid loft; solids need closed profiles.

Lesson 15 of 18 in the features course.

Practice

Loft the 40 × 40 square on the Top Plane to the 20 × 20 square 50 mm above. Check: volume 46,666.67 mm³ — a square frustum, h/3 × (A1 + A2 + √(A1·A2)).

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How many profiles does a loft need?

+

At least two. They are usually on different planes, and the loft follows the order shown in the Profiles box — use the arrows to change it.

Why is my loft twisted?

+

The connectors join different points of the profiles. Drag the green connector dots to matching points, or pick the profiles near matching corners.

Can a loft end at a point?

+

Yes, a sketch point can be the last profile, giving a pointed or domed end.

What is the difference between Loft and Boundary?

+

Boundary treats both directions equally and can control tangency and curvature at every curve, not just the ends. It usually gives smoother surfaces for complex shapes.