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Advanced parts · Lesson 16

SOLIDWORKS Design Library

The Design Library is a Task Pane tab for things you reuse: standard parts, features, annotations and sketch blocks. Drag an item onto your model to use it. Library features (.sldlfp files) are the most useful: save a feature once — a keyway, a mounting pattern, a vent slot — with its dimensions and references, and drop it onto any part.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Design Library task pane with folders and a library feature being dragged onto a part

Where to find it

Task Pane → Design Library (stacked-books icon)

Default Design Library folders

Folder Holds
Annotations Notes, symbols and blocks for drawings
Assemblies Reusable sub-assemblies
Features Library features (.sldlfp)
Forming tools Sheet metal forming tools
Motion Motion-related items
Parts Standard parts
Routing Routing components
Smart components Components that bring features with them

From GoEngineer's 2024 overview. Toolbox (Professional and Premium) appears alongside them; if it misbehaves, see Toolbox errors. Keep library folders in a shared location for teams — see organising files and folders. This is the last lesson of the course; next comes the assemblies course, starting with assembly basics.

Need more parts? Supplier and community libraries are compared in free SOLIDWORKS models and GrabCAD vs 3D ContentCentral.

Step by step

  1. 1

    Add your own library folder

    Create a folder such as D:\CAD Library. In the Design Library tab click Add File Location and pick it (or add it under System Options → File Locations → Design Library).

  2. 2

    Model the feature to reuse

    On a simple base block, cut a 20 × 10 mm slot 5 mm deep, dimensioned to two edges of the face. Those edges become the references.

  3. 3

    Save it as a library feature

    Select the slot feature (not the base), then File → Save As → Lib Feat Part (.sldlfp) — SOLIDWORKS jumps to the Design Library folder. Library features are marked with an L* in the tree.

    Save As dialog with Lib Feat Part sldlfp type and a slot feature marked with an L in the tree
    Save only the feature to reuse as a library feature.
  4. 4

    Insert it into another part

    Drag the .sldlfp from the Design Library onto a face of another part. Pick the configuration, then select the edges that replace the original references when prompted.

Common mistakes

  • Saving the base block as part of the library feature. Only the features to reuse should be library features; the base is placeholder geometry.
  • References that are hard to map later. Dimension the feature to simple edges and faces.
  • Keeping libraries in the hidden default ProgramData folder, which can be left behind on upgrades. Use your own folder.

Lesson 16 of 16 in the advanced parts course.

Practice

Save the 20 × 10 × 5 mm slot as a library feature and insert it into an 80 × 50 × 20 mm block. Check: the block's volume drops by 1,000 mm³ — from 80,000 to 79,000 mm³.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

What is a library feature in SOLIDWORKS?

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A feature saved as a .sldlfp file in the Design Library, with its dimensions and references, so it can be dragged onto other parts.

Where is the SOLIDWORKS Design Library stored?

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By default in a hidden folder under ProgramData for each version. You can add your own folders with Add File Location or under File Locations.

Is Toolbox part of the Design Library?

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Toolbox, available in SOLIDWORKS Professional and Premium, is reached from the Design Library tab. It has its own database and settings.

What is 3D ContentCentral?

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An online library of supplier and user CAD models reached from the Design Library. Downloading needs an account.