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Errors & Fixes

SOLIDWORKS Toolbox and Hole Wizard errors — fixes

Toolbox is the SOLIDWORKS library of standard fasteners and other parts, and the Hole Wizard uses the same database. Almost every Toolbox error has one of two causes: SOLIDWORKS points to a Toolbox folder of the wrong version (or one that no longer exists), or different users work with different Toolbox folders and settings. Fix the folder location first, then make everyone share the same Toolbox.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Standard bolts, nuts and washers with a database icon showing a version mismatch
The database file …\swbrowser.sldedb is not the expected version

Applies to: SOLIDWORKS 2022–2027 Toolbox and Hole Wizard, local, network and PDM setups.

Most likely causes

  1. Hole Wizard/Toolbox option points to an old or deleted SOLIDWORKS Data folder (most common)
  2. Several SOLIDWORKS Data folders on one PC after upgrades (common)
  3. Each user has a separate local Toolbox or different settings (wrong sizes)
  4. Toolbox add-ins not loaded (Toolbox missing)
  5. Toolbox in use or read-only during an upgrade (upgrades)

Toolbox error messages

Message Cause Fix
The database file …swbrowser.sldedb is not the expected version Folder from another release Fixes 1–2
SOLIDWORKS database "sldbrowser.sldedb" is missing Folder moved or deleted Fixes 1–2
Could not find the Standards database Several Data folders, wrong one selected Fixes 1–2
The Hole Wizard … database is not the expected version Same as above Fixes 1–2
Toolbox is currently in use Toolbox open during upgrade Fix 6
Fasteners open at the wrong size Different Toolboxes per user Fix 4
Hole Wizard/Toolbox options page with the Toolbox folder path set to C:\SOLIDWORKS Data
Point this option to the Toolbox folder that matches your release.

Avoid it next time

  • When you install a new release, click Change next to the Toolbox/Hole Wizard options in the Installation Manager and give the folder a year suffix, for example C:\SOLIDWORKS Data 2026. Then you always know which folder belongs to which release.
  • Keep one shared Toolbox for the whole team.
  • Use Pack and Go with Toolbox parts included when sending assemblies to people outside your company.

If parts other than Toolbox components are missing when you open an assembly, see missing references. Default folder locations are listed in SOLIDWORKS file locations.

How the Hole Wizard uses this database: Hole Wizard tutorial.

Using Toolbox in assemblies: Toolbox fasteners.

Fixes, in order

  1. 1. Find the right Toolbox folder

    The default location is C:\SOLIDWORKS Data. Look for the folder that contains lang\English\swbrowser.sldedb. To see which release a Toolbox belongs to, open ToolboxFiles.index in that folder with Notepad: the first number is the release — 34 = 2026, 33 = 2025, 32 = 2024.

  2. 2. Point SOLIDWORKS to it

    Tools → Options → System Options → Hole Wizard/Toolbox → click the … button and select the top-level folder (the one that contains lang). Restart SOLIDWORKS. This fixes not the expected version, sldbrowser.sldedb is missing and could not find the Standards database.

  3. 3. Turn on both Toolbox add-ins

    Tools → Add-Ins: tick SOLIDWORKS Toolbox Library and SOLIDWORKS Toolbox Utilities in both columns (now and at start-up). Or click Add in now in the Design Library's Toolbox folder.

  4. 4. Stop parts changing size

    When a fastener opens at the wrong size on someone else's PC, their Toolbox does not have that size and falls back to the default. Give everyone the same Toolbox: one shared network folder or PDM vault, or the same copied SOLIDWORKS Data folder — not a OneDrive copy. In Toolbox Settings → User Settings choose the same option for everyone (create parts or create configurations), and under Permissions set the same for all users.

  5. 5. Fix read-only Toolbox parts

    Toolbox Settings has two choices for writing to read-only Toolbox parts: Always change read-only status of document before writing, or Error when writing to a read-only document. Choose the second with PDM so that files are checked out properly.

  6. 6. Upgrades — "Toolbox is currently in use"

    Close SOLIDWORKS on all PCs that use the Toolbox, delete swbrowser.ldb from the Toolbox data folder, and run the upgrade again. Back up the Toolbox before upgrading — the upgrade cannot be undone, and older releases cannot use the upgraded database.

  7. 7. Toolbox in PDM

    Copy SOLIDWORKS Data into the vault, enable Toolbox management in PDM Administration → SOLIDWORKS → Toolbox, and point Hole Wizard/Toolbox options on every client to the vault path. To upgrade, make sure no Toolbox files are checked out, check out swbrowser.sldedb, upgrade, then check it back in.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

Where is the SOLIDWORKS Toolbox folder?

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By default in C:\SOLIDWORKS Data. The location in use is set under Tools → Options → System Options → Hole Wizard/Toolbox. Many offices move it to a shared network folder or a PDM vault.

Why do Toolbox bolts change size when someone else opens my assembly?

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Their Toolbox is different from yours — another folder, version or settings — and does not contain that size, so the part falls back to the default configuration. Share one Toolbox between all users.

Can I use a Toolbox from a newer SOLIDWORKS version?

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No. Each release needs a Toolbox database of the same version. Once a Toolbox is upgraded, older releases cannot use it, so back it up before upgrading.

Do I need Toolbox to use the Hole Wizard?

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The Hole Wizard uses the same database file (swbrowser.sldedb) for its standard hole sizes, so a wrong Toolbox folder causes Hole Wizard errors too.