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Assemblies · Lesson 1

SOLIDWORKS assembly basics

An assembly is a file (.sldasm) that places parts relative to each other. It does not copy the parts — it links to the part files and stores their positions and the mates between them. The first part you insert is usually fixed at the origin; every other part floats with six degrees of freedom until mates take them away.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Plate fixed at the assembly origin with two pins floating above it before mating

Where to find it

File → New → Assembly; Assembly tab → Insert Components

Tree symbols

Symbol Meaning
(f) Fixed — cannot move
(-) Under defined — can still move
(+) Over defined — conflicting mates
(none) Fully defined by mates

Moving components

Action How
Move Left-drag a face (moves in the plane of the view)
Rotate Right-drag
Exact move Move Component: along XYZ, along an entity, by delta, to a position
Exact rotation Rotate Component: about an entity or by delta
Free a fixed part Right-click → Float

Move Component also has collision detection (stops at contact) and dynamic clearance. Positions set by dragging are not stored as rules — mates are. Next: standard mates.

Step by step

  1. 1

    Model the parts

    Make two parts and save them: a plate 100 × 60 × 10 mm with two Ø10 through holes, and a pin Ø10 × 30 mm.

  2. 2

    Start the assembly with the plate

    File → New → Assembly. In Begin Assembly pick the plate and click the green tick — the plate is placed at the assembly origin and fixed. It shows (f) in the tree.

    Begin Assembly PropertyManager with the plate selected and the green tick placing it at the origin
    The green tick places the first component at the origin and fixes it.
  3. 3

    Insert the pins

    Assembly tab → Insert Components, pick the pin and click in the graphics area to drop it — do not use the green tick, or it is also fixed. Insert it a second time. The pins show (-): they can still move.

  4. 4

    Move and rotate them

    Left-drag a pin to move it; right-drag to rotate it. For exact moves use Move Component (along XYZ, by delta, to a position).

  5. 5

    Save and package

    Save the assembly in the same folder as the parts. To send it to someone, use File → Pack and Go, which collects the assembly and all its part files.

Common mistakes

  • Clicking the green tick for every component — each one is then fixed at the origin and cannot be mated.
  • Fixing a component that already has mates, which causes mate errors. Float it, or delete the conflicting mates.
  • Sending only the .sldasm file. Without the part files the assembly opens empty — use Pack and Go.
  • Renaming part files in Windows Explorer, which breaks the links. Use the SOLIDWORKS rename tools.

Lesson 1 of 16 in the assemblies course.

Practice

Insert the plate (fixed) and two pins (floating). Check: Evaluate → Mass Properties on the assembly gives 63,141.59 mm³ (plate with two holes 58,429.20 + two pins 2 × 2,356.19), whatever the pin positions — mass properties do not care about overlaps. Mate the pins in the next lesson.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I start an assembly in SOLIDWORKS?

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File → New → Assembly. The Begin Assembly PropertyManager opens; pick a part and click the green tick to place it fixed at the origin.

What does (f) mean in an assembly?

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The component is fixed: locked in all six degrees of freedom. (-) means it can still move, and (+) means it is over defined.

How do I unfix a component?

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Right-click it in the FeatureManager tree and choose Float. Then add mates to position it.

Does an assembly file contain the parts?

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No. It references the part files and stores positions and mates, so the part files must travel with it — Pack and Go collects them.