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Weldments · Lesson 1

Structural Member — your first weldment frame

Structural Member sweeps a standard profile — square tube, pipe, angle, channel or beam — along the lines of a layout sketch. Each member becomes a separate body in one weldment part. Segments are organised in groups that share a profile, and corner treatment decides how members meet: mitred or butted.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Table frame of square tube swept along a 3D layout sketch with mitred top corners

Where to find it

Weldments tab → Structural Member (turn on Weldments tab via right-click on CommandManager)

Options

Option Use
Standard / Type / Size Picks the profile from the weldment profiles folder
Groups / New Group Segments sharing one profile; contiguous or parallel
Apply corner treatment End Miter, End Butt1, End Butt2 for the group
Gap Gap between members of a group, or per corner
Mirror profile / Alignment / Rotation angle Orient the profile on the path
Locate Profile Choose another pierce point than the sketch origin
Merge miter trimmed bodies Combine mitred bodies (off by default)

Run Select Chain before the command to pick connected lines quickly — there is no chain selection inside it. Since 2019, Structure System offers a second way to build frames with members made from points, lengths and planes. Weldments are in every SOLIDWORKS package. Layout sketches are covered in 3D sketches.

Practise it: build the frame of the steel-frame chair.

Step by step

  1. 1

    Sketch the layout

    In a new part, open a 3D Sketch. Draw a 1000 × 500 rectangle on the XZ plane and four 400 mm vertical lines down from its corners. Lines and arcs work as paths; splines do not.

  2. 2

    Add the frame group

    Weldments tab → Structural Member. Standard iso, type square tube, a size from your library (for example 20 x 20 x 2). Select the four rectangle lines. Tick Apply corner treatment → End Miter.

    Structural Member PropertyManager with ISO square tube, two groups and End Miter corner treatment
    Pick standard, type and size; groups share a profile and a corner treatment.
  3. 3

    Add the legs as a new group

    Click New Group and select the four vertical lines — parallel segments can share a group. The legs are trimmed by the frame because group 1 comes first in the trim order. Click the tick.

  4. 4

    Look at the tree

    A Weldment feature and a Cut list folder appear. Each member is a body; identical bodies are collected into one cut list item.

Common mistakes

  • Three or more segments meeting at one vertex in the same group — use New Group.
  • Expecting a second Structural Member feature to trim against the first — joints between features need Trim/Extend.
  • Profile on the wrong side of the line — use Locate Profile to pick another pierce point.

Lesson 1 of 7 in the weldments course.

Practice

Build the 1000 × 500 frame with four 400 mm legs. Check: the cut list has 3 items with quantities 2, 2 and 4 — the long rails, the short rails and the legs, eight bodies in all.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I make a weldment frame in SOLIDWORKS?

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Sketch the layout (2D or 3D), click Structural Member, choose standard, type and size, and select the sketch segments as paths.

What is a group in Structural Member?

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A set of segments sharing one profile. They must be contiguous or parallel, and each group has its own corner treatment and trim order.

What corner treatments are there?

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End Miter, End Butt1 and End Butt2. Click the dot at a corner to override one corner.

Why are only a few profiles available?

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A new installation ships a few ANSI Inch and ISO sizes. Download full standards from Design Library → SOLIDWORKS Content → Weldments.