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Weldments · Lesson 6

Weldment cut lists

A weldment's cut list replaces the Solid Bodies folder. SOLIDWORKS groups identical bodies into cut list items and gives structural members properties such as Length, angles, material and quantity. In a drawing, a Weldment Cut List table turns them into the cutting list the workshop uses.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Weldment cut list folders in the tree next to a cut list table with lengths and quantities

Where to find it

FeatureManager → Cut list folder; right-click an item → Properties; drawing: Insert → Tables → Weldment Cut List

Cut list settings

Setting Where / since
Automatically create and update cut lists Document Properties → Weldments (on by default)
Rename folders with Description Document Properties → Weldments
Collect identical bodies, faces/features to exclude Right-click Cut list → Sorting Options (2017+)
Bounding box and custom description Right-click item → Create Bounding Box (description customisable since 2018)
Per-configuration properties Since 2019
Cut list IDs Document Properties → Weldments → Generate Cut list IDs (2021+)

Length is the normal distance between the end faces; Total Length sums items of the same profile, material and size. Drawing tables in general are covered in BOM and balloons.

Practise it: read the tube lengths from the cut list of the chair project.

Step by step

  1. 1

    Open the cut list

    In the finished table frame, expand Cut list. Each folder is a cut list item: identical bodies are collected, with the count in brackets.

  2. 2

    Read the properties

    Right-click a member item → Properties. The Cut-List Properties dialog shows Length, Angle1, Angle2, Material, Quantity and more.

    Cut-List Properties dialog with Length, Angle1, Angle2, Material and Quantity for a structural member
    Structural members get length, angles, material and quantity automatically.
  3. 3

    Add bounding boxes for plates

    Right-click the gusset and end cap items → Create Bounding Box. They get thickness, width, length and a description.

  4. 4

    Put it on a drawing

    In a drawing of the frame, select a view → Insert → Tables → Weldment Cut List. The default template is cut list.sldwldtbt.

Common mistakes

  • No Cut list folder — set Solid Bodies to Automatic in System Options → FeatureManager.
  • Bodies that differ slightly (a hole in another place, a different material) do not group.
  • Comparing the drawing table with the As Machined configuration — the table follows the default (As Welded) state.

Lesson 6 of 7 in the weldments course.

Practice

Open the cut list of the finished frame (rails, legs, cross member, one gusset, end caps). Check: the item quantities add up to the body count — 2 + 2 + 4 + 1 + 1 + 4 = 14 bodies — and each member item shows a Length.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I update a weldment cut list?

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It updates automatically by default. For large weldments you can turn that off in Document Properties → Weldments and right-click → Update.

What cut list properties do structural members get?

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Eight system properties: Length, Angle1, Angle2, Angle Direction, Angle Rotation, Material, Quantity and Total Length.

How do I add a cut list table to a drawing?

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Select a view of the weldment and use Insert → Tables → Weldment Cut List.

Can I use cut list properties in a title block?

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Since SOLIDWORKS 2026 cut list properties can be linked from File Properties into notes and title blocks.