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Sketching · Lesson 2

SOLIDWORKS rectangle tools

SOLIDWORKS has five rectangle tools. Corner Rectangle uses two opposite corners; Center Rectangle starts from the middle, which makes it the best choice for shapes centred on the origin; the two 3-Point types draw rectangles at an angle; and Parallelogram draws a four-sided shape whose corners need not be square. Every type can add construction lines from the corners or the midpoints.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Five rectangle types — corner, center, 3 point corner, 3 point center and parallelogram — sketched side by side

Where to find it

Sketch tab → Rectangle flyout

The five rectangle tools

Tool Clicks Best for
Corner Rectangle Two opposite corners Shapes positioned from one corner
Center Rectangle Centre, then a corner Parts symmetric about the origin
3 Point Corner Rectangle Two points for one side, then the width Rectangles at an angle
3 Point Center Rectangle Centre, direction, then size Angled rectangles around a centre
Parallelogram Like 3 Point Corner, corners not square Slanted shapes

The Add construction lines option works for every rectangle type. In SOLIDWORKS 2025 SP2 and later, holding Shift while dragging a rectangle draws a square — see the keyboard shortcuts.

Step by step

  1. 1

    Choose Center Rectangle

    Open a sketch on the Front Plane and pick Rectangle → Center Rectangle.

  2. 2

    Click the origin, then a corner

    Click on the origin for the centre, then click anywhere for a corner. The rectangle is symmetric about the origin, so it needs only two dimensions.

  3. 3

    Add the dimensions

    Use Smart Dimension: click the top line → 80, a side line → 50. The sketch turns black.

    Center rectangle 80 by 50 mm on the origin with construction diagonals, fully defined
    A center rectangle on the origin needs only width and height.
  4. 4

    Optional — add construction lines

    In the PropertyManager tick Add construction lines and choose From Corners (diagonals) or From Midpoints. They give you a centre point to snap holes to.

Common mistakes

  • Drawing a corner rectangle near the origin and then needing extra dimensions to centre it. Use Center Rectangle.
  • Dimensioning all four sides. Opposite sides are already equal through the parallel and perpendicular relations, so extra dimensions make the sketch over defined.
  • Using a rectangle when the corners must be at an angle — use a 3 Point type or Parallelogram.

Lesson 2 of 17 in the sketching course.

Practice

Draw an 80 × 50 mm Center Rectangle on the origin with construction lines from the corners, and extrude it 10 mm. Check: volume 40,000 mm³. Then add a Ø20 circle on the intersection of the diagonals and cut it through: the volume drops to 36,858.41 mm³.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I draw a rectangle from the centre in SOLIDWORKS?

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Use Rectangle → Center Rectangle. Click the centre point (usually the origin), then a corner.

How do I draw a rotated rectangle?

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Use 3 Point Corner Rectangle or 3 Point Center Rectangle. They let you set the direction of the first side, so the rectangle can sit at any angle.

Why does my rectangle need only two dimensions?

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The rectangle tools add relations that keep opposite sides parallel and corners square. A width and a height, plus a position, are enough to fully define it.

What are construction lines in a rectangle?

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Optional construction diagonals (from corners) or centre lines (from midpoints). They do not create geometry, but give you points to dimension and snap to.