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Sketching · Lesson 1

SOLIDWORKS Line tool

The Line tool draws straight segments. Click, release and click again to draw a chain of connected lines — the fastest way to sketch an outline — and double-click or press Esc to stop. The same flyout holds Centerline (construction lines for symmetry and revolve axes) and Midpoint Line, which grows symmetrically from its middle. Press L with a plane selected to start a sketch and the Line tool in one go.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Chain of connected sketch lines forming an L-shaped outline with a horizontal relation icon

Where to find it

Sketch tab → Line (flyout: Line, Centerline, Midpoint Line)

Shortcut

L

Line tool options

Option What it does
As sketched Line goes wherever you click
Horizontal / Vertical Forces the direction; you only set the length
Angle Forces a set angle
For construction Makes the line construction geometry
Infinite length Draws a line with no ends (for references)
Midpoint line Starts from the middle, growing both ways (since SOLIDWORKS 2015)

Options are in the Line PropertyManager on the left. Turning on Enable on screen numeric input in the sketch options lets you type length and angle while drawing; Tab moves between the fields.

The three line types

  • Line — normal geometry used to build features.
  • Centerline — dashed construction line for symmetry, mirroring and revolve axes. See construction geometry.
  • Midpoint Line — click the middle, then one end; the line grows equally both ways, with a midpoint you can tie to the origin.

Step by step

  1. 1

    Start the line

    Select the Front Plane and press L (or open a sketch and click Line). Click on the origin to place the first point — a coincident relation ties it there.

  2. 2

    Draw a chain

    Move the pointer and click to end the first segment; the next segment starts from there automatically. When a yellow H or V icon appears, the line will get a Horizontal or Vertical relation.

  3. 3

    Switch to an arc without changing tools

    To continue with a tangent arc, move the pointer away from the last point, back onto it, then away again — the line turns into an arc. You can also press A to toggle between line and arc.

    Line tool switching to a tangent arc by moving the pointer back to the endpoint
    Move back onto the endpoint and away again to switch from line to tangent arc.
  4. 4

    Close and finish

    Click the first point to close the outline, then double-click, press Esc or right-click → End chain. A closed outline is needed for Extrude, Cut and Revolve.

  5. 5

    Dimension it

    The length shown while drawing is only a preview. Add dimensions with Smart Dimension to fix the sizes.

Common mistakes

  • Trusting the length shown while drawing — it is not stored. Add a dimension.
  • Leaving a tiny gap where the outline should close; the extrude then fails. Turn on Shaded Sketch Contours to check.
  • Using a normal line for a revolve axis or mirror line. Use a Centerline so it is construction geometry.
  • Click-dragging when you wanted a chain — click-drag draws one separate line.

Lesson 1 of 17 in the sketching course.

Practice

On the Front Plane draw an L-shaped outline with the Line tool: 60 mm wide, 40 mm tall, both legs 10 mm thick, with the outer corner on the origin. Extrude it 10 mm. Check: Mass Properties should show a volume of 9,000 mm³.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

What is the shortcut for the Line tool in SOLIDWORKS?

+

L. With a plane or flat face selected, pressing L also opens a new sketch on it.

How do I stop drawing lines in SOLIDWORKS?

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Double-click, press Esc, or right-click and choose End chain. Clicking the start point closes the outline.

How do I draw an arc from the end of a line?

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Without leaving the Line tool, move the pointer back onto the last endpoint and away again, or press A. The next segment becomes a tangent arc.

What is the difference between Line and Centerline?

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A centerline is construction geometry: it is not used to build the solid. Use it for symmetry, mirror lines and revolve axes.