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Sheet metal · Lesson 2

Edge Flange in SOLIDWORKS sheet metal

Edge Flange bends a wall up from an edge of a sheet metal part, using the part's thickness and bend radius. Two settings decide the final size: how the length is measured (to the outer or inner virtual sharp, or to the bend tangent) and where the flange sits relative to the edge (material inside, material outside, bend outside and more). Get them right and the drawing dimension matches the part.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Sheet metal base with a 30 mm edge flange bent up along the 100 mm edge

Where to find it

Sheet Metal tab → Edge Flange; select a linear edge

Length and position options

Option Choices
Flange length Blind or Up To Edge And Merge
Measured from Outer Virtual Sharp, Inner Virtual Sharp, Tangent Bend
Flange position Material Inside, Material Outside, Bend Outside, Bend from Virtual Sharp, Tangent to Bend
Angle Value or parallel/perpendicular to a face
Custom relief Obround, rectangle or tear for this flange only
Multi-Length Flange (2025+) A different length per edge

Since 2015 Edit Flange Profile opens a rectangular sketch you can reshape freely. Since 2025 a document property can add flange length dimensions automatically. The flat length of this flange is worked out step by step in the K-factor calculator.

Practise it: four edge flanges make the sheet metal box project.

Step by step

  1. 1

    Pick the edge

    Open the 100 × 60 base flange. Edge Flange, click one of the 100 mm top edges and drag the preview upward.

  2. 2

    Set angle and length

    Angle 90°. Flange Length: Blind, 30 mm, measured from the Outer Virtual Sharp.

    Edge Flange PropertyManager with angle 90, length 30 to outer virtual sharp and Material Inside position
    Length to the outer virtual sharp plus Material Inside keeps outside dimensions exact.
  3. 3

    Set the position

    Flange Position: Material Inside, so the flange stays inside the base outline and the 60 mm dimension does not change. Click the tick.

  4. 4

    Reshape if needed

    Right-click the flange's sketch → Edit Sketch (or use Edit Flange Profile during creation) to make a partial or shaped flange instead of cutting it afterwards.

Common mistakes

  • Wrong flange position — Material Outside adds the thickness to the base, so 60 becomes 62.
  • Tangent Bend length with an angle below 90° — it errors and resets to 90°; use a virtual sharp option.
  • Cutting a flange to shape with Extrude Cut — Edit Flange Profile gives the same flat and rebuilds faster.

Lesson 2 of 13 in the sheet metal course.

Practice

Add a 30 mm edge flange to a 100 mm edge, outer virtual sharp, material inside. Check: the part measures 100 × 60 × 30 outside, Mass Properties shows 17,342.48 mm³, and the flat pattern is 100 × 86.71 mm.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I add a flange in SOLIDWORKS sheet metal?

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Click Edge Flange, select a linear edge, set the angle, the length and the flange position, and click OK.

What is the outer virtual sharp?

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The point where the outside faces of the two walls would meet without the bend. Measuring flange length to it matches the outside dimension.

What do the flange position options mean?

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They place the flange relative to the selected edge: material inside, material outside, bend outside, bend from virtual sharp or tangent to bend.

Can one edge flange have different lengths?

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Since SOLIDWORKS 2025, the Multi-Length Flange option sets a different length for each selected edge.