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Sheet metal · Lesson 4

Hems in SOLIDWORKS sheet metal

A hem folds the edge of a sheet back on itself. It stiffens the edge, hides burrs and removes a sharp edge people could cut themselves on. SOLIDWORKS offers closed, open, tear drop and rolled hems, placed inside or outside the edge, with settings for length, gap, angle and radius.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Four sheet metal edge profiles showing closed, open, tear drop and rolled hems

Where to find it

Sheet Metal tab → Hem; select an edge

Hem types

Type Set by Use
Closed Length Flat fold, no gap — stiff, safe edge
Open Length and gap Fold with a gap, easier on harder materials
Tear drop Angle and radius Rounded fold with closed tip
Rolled Angle and radius Curl, for example 270°

Hems can also take a custom bend allowance and miter gap. The next feature, Jog, offsets a wall with two bends.

Step by step

  1. 1

    Select the edge

    Open the bracket from lesson 2. Hem, click the top outer edge of the 30 mm flange.

  2. 2

    Choose the type

    Type Closed, position Material Inside, length 10 mm. A closed hem has no gap.

    Hem PropertyManager with Closed type, Material Inside and length 10 mm
    Choose the hem type, its position and length.
  3. 3

    Adjust the width

    Edit Hem Width opens a sketch: drag the ends inward and dimension them for a partial hem. Click the tick.

Common mistakes

  • Hems too short for the press brake tools — a rule of thumb is about 10 × the thickness.
  • Hems on neighbouring edges that clash at the corner — they mitre differently from a miter flange; check the corner or model the hem as a miter flange.
  • Closed hems on hard material that cracks — use an open or tear drop hem.

Lesson 4 of 13 in the sheet metal course.

Practice

Add a 10 mm closed hem to the top edge of the 30 mm flange. Check: measured across the top, the hemmed edge is 4 mm thick — two layers of 2 mm with no gap.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I add a hem in SOLIDWORKS?

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Click Hem on the Sheet Metal tab, select an edge, choose the type and position, set length, gap or radius, and click OK.

What hem types are there?

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Closed, Open, Tear Drop and Rolled. Rolled hems are set by radius and roll angle, for example 270°.

Why use a hem?

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To stiffen the edge, hide burrs and avoid sharp edges.

How long should a hem be?

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A rule of thumb is about 10 times the material thickness, so the bending tools have room to grip it.