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Sheet metal · Lesson 1

Base Flange — the first sheet metal feature

A sheet metal part usually starts with Base Flange/Tab. Sketch a closed profile for a flat blank or an open profile for a bent section, and the feature adds thickness. It also sets the part's defaults — thickness, bend radius, bend allowance and relief — which every later flange, hem and bend inherits. SOLIDWORKS adds a Sheet-Metal feature and a Flat-Pattern to the tree.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Flat sheet metal base flange 100 by 60 mm with the Sheet-Metal and Flat-Pattern features in the tree

Where to find it

Sheet Metal tab → Base Flange/Tab; Insert → Sheet Metal → Base Flange

Base Flange options

Section What it sets
Direction 1 Depth for open profiles, like an extrude
From (2026+) Start offset from the sketch plane, a vertex or a face
Sheet Metal Gauges Use a gauge table instead of typed values
Sheet Metal Parameters Thickness, bend radius, reverse direction
Bend Allowance K-Factor (default 0.5), bend allowance, bend deduction, bend table, bend calculation
Auto Relief Rectangular, tear or obround, with relief ratio

Profile types

  • Closed profile — a flat blank (a tab), like our 100 × 60 plate.
  • Open profile — a bent section such as an L or U, given a depth in Direction 1.
  • Several closed profiles — nested contours give a blank with cut-outs.

Since 2013 sheet metal bodies and their flat patterns sit in separate folders in the tree. The bend values are explained in K-factor and bend tables.

Step by step

  1. 1

    Show the Sheet Metal tab

    In a new part, right-click any CommandManager tab and tick Sheet Metal if the tab is missing.

  2. 2

    Sketch the blank

    On the Top plane, sketch a 100 × 60 rectangle centred on the origin.

  3. 3

    Base Flange

    Base Flange/Tab. Under Sheet Metal Parameters set thickness 2 and bend radius 2. Under Bend Allowance keep K-Factor 0.5; under Auto Relief keep Rectangular. Click the tick.

    Base Flange PropertyManager with thickness 2 mm, bend radius 2 mm, K-Factor 0.5 and rectangular auto relief
    Thickness, radius, bend allowance and relief set here become the part's defaults.
  4. 4

    Look at the tree

    The tree now has a Sheet-Metal feature (the defaults), the Base-Flange1 feature and a Flat-Pattern folder. Change defaults later by editing Sheet-Metal.

Common mistakes

  • Building sheet metal with Extrude and then wondering why it will not flatten — start with Base Flange or convert the solid.
  • Bend radius smaller than the thickness — the metal can crack; a radius at least equal to the thickness is a safe start.
  • Keeping K = 0.5 for production parts — the default is often not right; get values from your fabricator.

Lesson 1 of 13 in the sheet metal course.

Practice

Make the 100 × 60 base flange, 2 mm thick, R2, K 0.5. Check: Mass Properties shows a volume of 12,000 mm³. Keep the part — the next lessons add flanges to it.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I start a sheet metal part in SOLIDWORKS?

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Sketch a profile and click Base Flange/Tab on the Sheet Metal tab. Set thickness, bend radius and bend allowance; they become the part's defaults.

Can a base flange use an open sketch?

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Yes. A closed profile gives a flat blank; an open profile is extruded like a thin feature with bends at its corners.

What is the default K-factor in SOLIDWORKS?

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K-Factor is the default bend calculation and the default value is 0.5, which is often not correct for real parts.

What auto relief types are there?

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Rectangular, Tear and Obround. Rectangular and obround reliefs use a relief ratio between 0.05 and 2.0 times the thickness.