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Features · Lesson 16

SOLIDWORKS Boundary Boss/Base

Boundary Boss/Base builds a solid from curves in two directions, like a net. It looks similar to Loft, but treats both directions equally: the curves you would use as guide curves in a loft become Direction 2. It follows the input curves more closely and can control tangency and curvature at every curve, not just the first and last, which is why designers prefer it for smooth consumer-product shapes.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Smooth boundary solid built from curves in two directions forming a net

Where to find it

Features tab → Boundary Boss/Base (Insert → Boss/Base → Boundary)

Loft vs Boundary

Loft Boundary
Inputs Profiles + optional guide curves Curves in Direction 1 and Direction 2
Directions Profiles lead, guides follow Both directions equal
Tangency / curvature control At the first and last profiles At every curve, in both directions
Follows input curves Approximately More closely
Best for Simple transitions Smooth freeform and consumer shapes

From GoEngineer's comparison of the two features. Boundary also exists as a cut and as a surface feature — see Boundary Surface.

Step by step

  1. 1

    Reuse the loft sketches

    Use the same two sketches as in the Loft lesson: a 40 × 40 square on the Top Plane and a 20 × 20 square 50 mm above.

  2. 2

    Create the boundary

    Boundary Boss/Base → pick the two squares in Direction 1, near matching corners. With no Direction 2 curves and no tangency set, the result matches the loft.

    Boundary feature with two square profiles in Direction 1 and two side curves in Direction 2
    Direction 1 holds the profiles; Direction 2 holds the cross curves.
  3. 3

    Add Direction 2 curves

    Sketch a curved line on the Front Plane from a corner of the bottom square to the matching corner of the top square, and another on the Right Plane. Add them in Direction 2. The sides now bulge along these curves.

  4. 4

    Compare with Loft

    Build the same shape as a loft with the curves as guide curves and compare the faces with Zebra Stripes (Evaluate tab). Boundary usually gives smoother transitions.

Common mistakes

  • Curves in Direction 2 that do not touch every Direction 1 profile — the boundary fails.
  • Expecting Boundary to be faster to set up for simple transitions; for two simple profiles Loft is enough.
  • Mismatched connectors twisting the shape, as with lofts.

Lesson 16 of 18 in the features course.

Practice

Build the boundary between the two squares without Direction 2 curves. Check: volume 46,666.67 mm³, the same as the loft. Then add the two Direction 2 curves and see the volume change as the sides bulge.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

What is the difference between Loft and Boundary in SOLIDWORKS?

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Loft uses profiles plus optional guide curves and controls tangency only at the ends. Boundary uses curves in two equal directions, follows them more closely and can control tangency or curvature at each curve.

When should I use Boundary instead of Loft?

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For smooth freeform shapes where surface quality matters — handles, housings, consumer products — and when you need curvature continuity to neighbouring faces.

Does Boundary need closed profiles?

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For a solid (Boundary Boss/Base) the Direction 1 profiles must form a closed shape. Boundary Surface also works with open curves.