Skip to content
SOLID WORKS ClubSOLID WORKS Club

Features · Lesson 17

SOLIDWORKS Dome

Dome bulges a face outward (or inward) by a set distance — the rounded top of a button, the dimpled base of a bottle, a raised bump on a panel. Pick the face and the height, and SOLIDWORKS builds the curved surface. On cylinders and cones you can make an elliptical dome; on polygons a continuous dome that blends smoothly from the sides.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Cylinder with a domed top next to a cup with a concave dome in its base

Where to find it

Insert → Features → Dome (or the Features toolbar)

Dome options

Option What it does
Faces to Dome One or more faces, flat or curved
Distance Height of the dome
Reverse direction Concave dome
Constraint point or sketch Shapes the dome with a sketch (disables Distance)
Direction Dome along a chosen direction
Elliptical dome Half-ellipse profile on cylinders and cones
Continuous dome Even slope from all edges on polygons

For lettering and logos on curved faces, see the next lesson, Wrap.

Step by step

  1. 1

    Make a cylinder

    Extrude a Ø40 circle on the Top Plane 20 mm up.

  2. 2

    Start Dome

    Insert → Features → Dome. Pick the top face in Faces to Dome.

  3. 3

    Make it elliptical

    Set the distance to 20 mm and tick Elliptical dome. With a height equal to the cylinder's radius, the elliptical dome is a hemisphere.

    Dome PropertyManager with the top face of a cylinder selected, distance 20 mm and elliptical dome ticked
    An elliptical dome with height equal to the radius gives a hemisphere.
  4. 4

    Try a concave dome

    Edit the feature and click Reverse direction — the dome now goes into the cylinder, like the base of a bottle. Set it back for the practice check.

Common mistakes

  • Expecting a constraint sketch and a distance at the same time — a constraint disables the distance.
  • Continuous dome on a four-sided face — it is not available there.
  • Using Dome for precise curved surfaces you must dimension on a drawing. A revolve gives exact radii.

Lesson 17 of 18 in the features course.

Practice

Add a 20 mm elliptical dome to the top of a Ø40 × 20 mm cylinder. Check: volume 41,887.90 mm³ — the cylinder (25,132.74 mm³) plus a hemisphere of R20 (16,755.16 mm³).

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I make a concave dome?

+

Click Reverse direction in the Dome PropertyManager. The dome goes into the part instead of out of it.

What is an elliptical dome?

+

A dome option for cylindrical and conical faces that gives a half-ellipse profile. When its height equals the radius, the result is a hemisphere.

Can I dome a non-flat face?

+

Yes, Dome accepts planar and non-planar faces.

What is a continuous dome?

+

An option for polygonal faces that slopes the dome up evenly from all edges. It is not available on four-sided faces or with a constraint or direction.