Skip to content
SOLID WORKS ClubSOLID WORKS Club

Drawings · Lesson 4

SOLIDWORKS detail views

A detail view enlarges a small area of another view — a fillet, a groove, a thread — so it can be dimensioned clearly. Draw a circle (or any closed profile) around the area, place the enlarged view, and set its scale. It works on any view, including section and auxiliary views.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Drawing with a detail circle around a corner and an enlarged detail view at 2 to 1

Where to find it

View Layout tab → Detail View

Detail view options

Option What it does
Circle / Profile Shape of the detail boundary
Style Per Standard, Broken Circle, With Leader, No Leader, Connected
Label Letter and text of the view name
Scale Use the parent's scale or a custom scale
Jagged outline / No outline (2017+) Outline style; a shape-intensity slider sets how jagged

Detail views show true-size dimensions — next comes Broken-out section, another way to reveal small internal features.

Step by step

  1. 1

    Start the detail view

    On the plate drawing, Detail View. In the front view, click near one rounded corner and drag a circle around it.

  2. 2

    Place it

    Move the pointer to an empty area and click. The view is labelled Detail B (letters continue from the section view).

    Detail circle around a rounded corner and the enlarged detail view being placed
    Circle the area, place the view, set the scale.
  3. 3

    Set the scale

    In the PropertyManager choose a custom scale of 2:1. The R5 corner is now large enough to dimension.

  4. 4

    Change the style

    Try styles such as Connected (the detail joined to its circle) or With leader. A closed sketch selected before the command gives a profile-shaped detail.

Common mistakes

  • Detail circle drawn freehand and then missing the feature after a model change. Edit its sketch and tie it to geometry.
  • Dimensioning the detail and expecting doubled values. Dimensions always show true size, whatever the scale.
  • Too small a scale for the feature — use a scale where text and arrows fit.

Lesson 4 of 14 in the drawings course.

Practice

Create Detail B of one rounded corner at 2:1 and dimension the radius. Check: the dimension reads R5, not R10 — dimensions show true size at any view scale.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I make a detail view in SOLIDWORKS?

+

Click Detail View, draw a circle around the area on a view, then click to place the enlarged view and set its scale.

Can a detail view have a non-circular shape?

+

Yes. Sketch a closed profile on the view, select it, then start Detail View; set the style to Profile.

What detail styles are there?

+

Per Standard, Broken Circle, With Leader, No Leader and Connected. Since 2017 detail and crop views can also have a jagged outline or no outline.

Does the detail view scale change dimensions?

+

No. Dimensions always display the model's true size.