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SOLID WORKS ClubSOLID WORKS Club

Drawings · Lesson 5

Broken-out sections and break views

A broken-out section cuts away part of an existing view to show what is inside — a hole, a pocket, a thread — without making a separate section view. You draw a closed outline (usually a spline) on the view and set how deep to cut. A break view does something different: it shortens a long, uniform part such as a shaft or tube so it fits the sheet, with the dimensions still showing the full length.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Drawing view with a spline-bounded broken-out section revealing a hole, and a broken shaft view

Where to find it

View Layout tab → Broken-out Section; Break

Broken-out section vs section view vs break

Tool Result Use for
Broken-out Section Local cut inside an existing view Small internal features
Section View A separate cut view Whole cross-sections — see section view
Break Shortened view with a gap Long uniform shafts, tubes, profiles

Break lines can be changed by right-clicking them; since 2017 they can be jagged. Since 2016 a model break view also exists in the model itself.

Step by step

  1. 1

    Draw the outline

    On the plate drawing, Broken-out Section. The spline tool starts; click points around the hole area in the right view and close the spline on its first point.

  2. 2

    Set the depth

    In the dialog, pick the hole edge in another view as the depth (the cut goes to the hole centre) or type a depth. Tick Preview.

    Broken-out section dialog with depth set by selecting a hole edge and preview on
    Close the spline, then set the depth by an edge or a distance.
  3. 3

    Confirm

    Click the tick. The area inside the spline is cut away and hatched, showing the hole as a section.

  4. 4

    Shorten a long part with a break

    On a drawing of a long shaft, Break, place two break lines across the uniform middle, set the gap, and confirm. Dimensions across the break still show the full length.

Common mistakes

  • A depth edge that is not parallel to the preview plane — the cut lands at the wrong depth. Use Preview, and for round edges the cut goes to the centre.
  • Using a broken-out section where a full section is clearer. Use it for small, local features.
  • Breaks across features that change — break only the uniform part.

Lesson 5 of 14 in the drawings course.

Practice

Add a broken-out section around the hole in the plate's right view, with the depth set to the hole edge. Check: the cut-away area shows the hole as a gap 20 mm wide between hatched material.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

What is a broken-out section in SOLIDWORKS?

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A local cut inside an existing drawing view, defined by a closed profile and a depth. It is part of the view, not a separate view.

How do I set the depth of a broken-out section?

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Type a distance or select geometry, such as an edge in another view. Turn on Preview to check before confirming.

Can I add a broken-out section to a detail or section view?

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Yes, since SOLIDWORKS 2018 broken-out sections work on detail, section and alternate position views.

How do I shorten a long part on a drawing?

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Use Break: place break lines across the uniform section and set the gap. Dimensions still show the true length.