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Drawings · Lesson 3

SOLIDWORKS section views

A section view shows the inside of a part as if it were cut along a line. Since SOLIDWORKS 2013 the Section View tool places the cutting line for you: horizontal, vertical, auxiliary or aligned, with arc, single and notch offsets to step through several features. Cut faces are hatched; ribs and fasteners can be excluded from the cut, as drafting standards expect.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Drawing with a cutting line A-A on a front view and the hatched section view below

Where to find it

View Layout tab → Section View

Section view options

Option What it does
Cutting line Vertical, horizontal, auxiliary or aligned
Offsets Arc, single and notch offsets, combinable
Half section Cuts half the part (since 2013, command first)
Auto flip Arrows follow where you place the view
Section Scope Exclude components, ribs, fasteners; Toolbox parts are fasteners by default
Auto hatching Changes hatch angle between adjacent cut faces
Section depth / Slice Show only material up to a depth, or only the cut faces
Emphasized outline (2017+) Thick outline around cut faces

Section views are a CSWA drafting topic — see the CSWA guide.

Step by step

  1. 1

    Start a horizontal section

    On the plate drawing, Section View. Choose the Horizontal cutting line and click the centre of the hole in the front view.

    Section View Assist with a horizontal cutting line through the hole centre and the offset toolbar
    Pick the line type, click a point, then add offsets or confirm.
  2. 2

    Confirm the line

    Click the green tick on the pop-up toolbar (or add offsets first — arc, single or notch — to step the line through other features).

  3. 3

    Place the view

    Move the pointer below the front view and click. The view is labelled Section A-A. Tick Auto flip if the arrows should follow the side you place the view on.

  4. 4

    Check the hatching

    The cut faces are hatched; the hole appears as a gap. For assemblies, the Section Scope tab lets you exclude components, ribs and fasteners.

Common mistakes

  • A cutting line not tied to geometry. After a model change it may miss the feature. Edit the section line sketch and add relations.
  • Hatching fasteners and shafts in assembly sections. Exclude fasteners in Section Scope (Toolbox parts count as fasteners).
  • Section views that show everything behind the cut. Use Section Depth or Slice to show only what matters.

Lesson 3 of 14 in the drawings course.

Practice

Cut the plate's front view horizontally through the hole centre and place Section A-A below it. Check: the section shows two hatched rectangles, each 40 × 20 mm, with a 20 mm gap for the hole.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I make an offset section view?

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Place the cutting line with Section View, then add arc, single or notch offsets from the pop-up toolbar before confirming. You can also sketch a jogged line yourself.

How do I make a half section?

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Section View includes half-section options: choose the half-section shape and click the centre point. No sketch is needed (since 2013).

How do I exclude ribs or fasteners from a section?

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Use the Section Scope tab when creating the view, or later in the view's properties. Parts with an IsFastener = 1 property are treated as fasteners.

What is a removed section?

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A section placed away from the parent view, with its own command since SOLIDWORKS 2019.