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Weldments · Lesson 4

Gussets in SOLIDWORKS weldments

A gusset is a plate welded into a corner to stiffen it. In SOLIDWORKS you pick two flat faces that meet — at any angle — and choose a triangular or polygonal profile, its size, an optional chamfer that leaves room for the weld, the plate thickness and where it sits along the joint.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Triangular gusset plate with a chamfered inside corner welded between a leg and a rail

Where to find it

Weldments tab → Gusset

Options

Option Choices
Supporting faces Two planar faces meeting at any angle
Profile Triangular (two sizes) or polygonal (more sizes)
Chamfer Two lengths, or a length and an angle
Thickness One side, the other side, or both
Location Positions along the joint, with an optional offset

Gusset colour is set in Document Properties → Model Display. Repeat gussets with mirror or a pattern.

Step by step

  1. 1

    Pick the supporting faces

    In the table frame, Gusset. Select the outer face of one leg and the underside of the rail above it — the two faces that form the corner.

  2. 2

    Set the profile

    Profile Triangular, both sides 60 mm. Add an inside chamfer so the gusset clears the weld at the corner.

    Gusset PropertyManager with supporting faces, triangular profile 60 by 60 and a chamfer
    Two supporting faces, a profile and an optional chamfer for the weld.
  3. 3

    Thickness and location

    Thickness 5 mm, centred on the face (both sides), location in the middle of the member. Click the tick.

  4. 4

    Repeat

    One gusset per command: pin the PropertyManager to add more, or mirror/pattern the gusset bodies.

Common mistakes

  • Expecting several gussets from one command — it makes one; use the pushpin, mirror or pattern.
  • Settings carried over from the last gusset — check sizes every time.
  • Blank descriptions in the drawing cut list — right-click the gusset's Cut-List-Item → Create Bounding Box.

Lesson 4 of 7 in the weldments course.

Practice

Add one triangular 60 × 60 gusset, 5 mm thick, under one rail–leg corner. Check: the cut list gains a gusset item with quantity 1; after Create Bounding Box its description reads like Plate, 5 x … x ….

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I add a gusset in SOLIDWORKS?

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Click Gusset on the Weldments tab, select two planar faces that meet, choose the profile and size, thickness and location, and click OK.

Can a gusset sit in a non-90° corner?

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Yes. The two supporting faces can meet at any angle.

What is the chamfer on a gusset for?

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It cuts the inside corner of the plate so it does not clash with the weld bead at the joint.

Why does my gusset have no description in the cut list?

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Gussets get only a Material property. Create a bounding box on its cut list item to generate a description.