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SOLID WORKS ClubSOLID WORKS Club

Sketching · Lesson 13

SOLIDWORKS Offset Entities

Offset Entities copies sketch entities, model edges or the edges of a face at a set distance, like a parallel copy that follows curves. The copy stays linked: if the original changes, the offset follows. Use it for walls of constant thickness, lips and grooves, frames around a shape and clearance outlines.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Curved sketch outline with a parallel offset copy and a distance arrow

Where to find it

Sketch tab → Offset Entities (also Tools → Sketch Tools → Offset Entities)

Offset options

Option What it does
Distance Offset distance; drag or type it
Add dimensions Adds the offset distance as a dimension
Reverse Switches the side
Select chain Offsets all connected entities
Bi-directional Offsets to both sides
Cap ends (arcs or lines) Closes open-chain offsets; since 2016 also for one-direction offsets
Construction geometry: base / offset Turns the originals or the copies into construction

To offset the edges of a model face, select the face (or its edges) in the sketch — it is the same tool. To copy edges without a distance, use Convert Entities.

Step by step

  1. 1

    Draw the outer shape

    On the Front Plane draw a Center Rectangle 70 × 50 on the origin and dimension it.

  2. 2

    Offset it inward

    Select one of the rectangle's lines and click Offset Entities. Set the distance to 5 mm and tick Select chain so the whole rectangle is used. If the preview is outside, tick Reverse.

    Rectangle 70 by 50 offset 5 mm inward with Select chain and Reverse options
    Offset the whole chain inward by 5 mm.
  3. 3

    Confirm and extrude

    Click the tick. The new 60 × 40 rectangle is linked to the outer one. Exit the sketch and extrude it 10 mm — the area between the two rectangles becomes a frame.

Common mistakes

  • Offsetting only one line when you meant the whole outline — tick Select chain, or select a face to offset all its edges.
  • Offsetting a shape inward by more than its smallest radius allows; the offset fails or self-intersects.
  • Using two separate rectangles with four dimensions for a constant-width wall. One offset keeps the wall even when the outer size changes.

Lesson 13 of 17 in the sketching course.

Practice

Build the frame above: a 70 × 50 rectangle offset 5 mm inward, extruded 10 mm. Check: volume 11,000 mm³. Change the outer width to 80 — the inner rectangle should follow and the volume becomes 12,000 mm³.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I offset a whole sketch outline?

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Select one entity and tick Select chain in the Offset Entities PropertyManager, or select a face to offset all its edges at once.

Does the offset update when I change the original?

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Yes. The offset stays linked to the original entities and moves when they change.

How do I offset in both directions?

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Tick Bi-directional. For open chains you can cap the ends with arcs or lines, which turns an open line into a closed slot-like outline.

Can I offset onto a curved surface?

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Yes, with Offset on Surface in a 3D sketch. It offsets the edges of a surface along the surface, with geodesic or straight-line distance.