Skip to content
SOLID WORKS ClubSOLID WORKS Club

Sheet metal · Lesson 6

Sketched Bend in SOLIDWORKS sheet metal

Sketched Bend folds an existing flat sheet along lines you draw on it. It suits work that starts from a known blank — when the flat size is fixed by tooling or a customer drawing — because the flat pattern stays exactly the blank you began with. Lines can run at any angle to the edges.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Flat sheet metal plate with a sketched bend line, and the same plate bent 90 degrees along it

Where to find it

Sheet Metal tab → Sketched Bend

Bend positions

Position Where the bend sits
Bend Centerline Centred on the line (default)
Material Inside Material stays inside the line
Material Outside Material moves outside the line
Bend Outside Whole bend outside the line

The radius comes from the Sheet-Metal defaults unless you clear Use default radius; Custom Bend Allowance overrides the bend value. Flattening is covered in flat pattern.

Step by step

  1. 1

    Sketch the bend line

    On a 100 × 60 base flange (2 mm), sketch a line on the top face parallel to the 100 mm edge, 20 mm from it. Exit the sketch.

  2. 2

    Start Sketched Bend

    Select the sketch and click Sketched Bend. Click the larger side of the plate as the fixed face.

    Sketched Bend PropertyManager with fixed face, Bend Centerline position and 90 degree angle
    Pick the side that stays still, then the bend position and angle.
  3. 3

    Set position and angle

    Bend position Bend Centerline (the default), angle 90°, default radius. Click the tick.

  4. 4

    Flatten

    Flatten. The blank is the plate you started with.

Common mistakes

  • Clicking the wrong side as the fixed face — the "wrong" side moves.
  • Expecting outside dimensions to match the sketch — the bend position decides where the material ends up.
  • Using Sketched Bend for walls that need an exact outside height — Edge Flange is easier for that.

Lesson 6 of 13 in the sheet metal course.

Practice

Bend the 100 × 60 plate 90° along a line 20 mm from a long edge. Check: the flat pattern bounding box is still 100 × 60 mm — a sketched bend never changes the blank.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I bend sheet metal along a line in SOLIDWORKS?

+

Sketch the bend line on a face, click Sketched Bend, pick the fixed face, set the bend position and angle, and click OK.

What bend positions are there?

+

Bend Centerline (default), Material Inside, Material Outside and Bend Outside.

Can I bend only part of the sheet?

+

Yes. Colinear lines can bend some areas while a tab between them stays flat.

When should I use Sketched Bend?

+

When you start from a known flat blank, for example a size fixed by tooling, and want the flat to stay exactly that size.