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SOLID WORKS ClubSOLID WORKS Club

Drawings · Lesson 10

GD&T in SOLIDWORKS drawings

Geometric dimensioning and tolerancing (GD&T) controls form, orientation and position — how flat a face must be, how perpendicular, where a hole may sit — relative to datums. In SOLIDWORKS you place datum feature symbols on reference faces, then add feature control frames with the Geometric Tolerance tool. Since 2022 the frame is built cell by cell right in the graphics area.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Drawing with datum feature symbols A and B and a position feature control frame on a hole

Where to find it

Annotation tab → Datum Feature, Geometric Tolerance, Datum Target

GD&T tools

Tool Use
Datum Feature Labels a face or feature as datum A, B, C …
Geometric Tolerance Feature control frames; new builder since 2022
Datum Target Point, circular or rectangular target areas, up to three datum references
DimXpert (in the part) Size and location dimensions and tolerances in 3D
MBD (add-in) Model-based definition and 3D PDF publishing

Size tolerances on dimensions are covered in tolerances.

Step by step

  1. 1

    Place datum A

    On the plate drawing, Annotation → Datum Feature, attach symbol A to the bottom face in the front view, and B to the left edge.

  2. 2

    Add a feature control frame

    Geometric Tolerance, click the Ø20 hole dimension so the frame attaches to it. Build the frame: Position, tolerance zone Ø0.10, datums A and B.

    Geometric Tolerance builder with Position, diameter 0.10 and datums A and B
    Build the frame cell by cell — characteristic, zone, datums.
  3. 3

    Check the standard

    The symbols follow the drafting standard of the document (Document Properties → Drafting Standard). SOLIDWORKS supports ASME Y14.5 guidelines.

Common mistakes

  • Feature control frames without the datums they reference on the drawing.
  • Datum symbols on width features placed off the dimension line — under ASME Y14.5 they belong on it.
  • Using GD&T just to look professional. Every frame must be measurable and needed for function.

Lesson 10 of 14 in the drawings course.

Practice

Add datums A and B and a position tolerance of Ø0.10 to the hole relative to A and B. Check: the frame reads ⌖ | Ø0.10 | A | B next to the hole dimension, and datum symbols A and B appear on the referenced faces.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

How do I add a feature control frame in SOLIDWORKS?

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Annotation → Geometric Tolerance, click where to attach it (a dimension, face or leader), then build the frame: characteristic, tolerance, modifiers and datums.

When did the GD&T interface change?

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SOLIDWORKS 2022 introduced a new feature control frame builder that works in the graphics area, one cell at a time.

Which GD&T standard does SOLIDWORKS use?

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The drafting standard of the document decides symbol style. SOLIDWORKS supports ASME Y14.5 tolerancing guidelines and ISO drafting standards.

Can I put GD&T on the 3D model?

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Yes, with DimXpert and SOLIDWORKS MBD. DimXpert dimensions the model in 3D; the MBD add-in can publish 3D PDFs.