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SOLID WORKS ClubSOLID WORKS Club

Assemblies · Lesson 12

In-context external references

When a part is built in context — a sketch converted from another part, a feature extruded up to another part's face — it stores an external reference to that assembly. SOLIDWORKS marks it with an arrow in the tree and updates the part when the referenced geometry changes. That is powerful, but every reference is a dependency. Know how to read them, lock them when a design is settled, and break them when a part must stand alone.

Kevin Walsh Kevin Walsh Updated Checked for SOLIDWORKS 2026
Lid part linked to a base part with arrows and the four external reference symbols

Where to find it

Right-click a part or feature → List External Refs

Reference symbols

Symbol Status
-> External reference, in context
->* Locked — does not update
->x Broken — no longer updates; new references allowed
->? Out of context — the referenced assembly is not open
{->} A sketch inside the feature has an external reference

From the official FeatureManager tree conventions. Lock and Break are explained in Hawk Ridge's definitions of external references.

Lock vs Break

Lock Break
Updates Stop Stop
New references Not allowed Allowed
Reversible Yes — Unlock No

If referenced files go missing altogether, see missing references.

Step by step

  1. 1

    See the reference

    Open the assembly with the lid from the top-down lesson. In the tree, the lid and its feature show -> — an external reference.

  2. 2

    Change the referenced part

    Edit the plate and change its length from 100 to 120 mm. Rebuild the assembly (Ctrl + B). The lid grows with it.

    Plate length changed from 100 to 120 mm and the in-context lid growing to match
    The lid follows the plate while its references are active.
  3. 3

    List and lock the references

    Right-click the lid → List External Refs. The dialog shows each reference and its status. Click Lock All — the symbol becomes ->* and the lid no longer updates.

  4. 4

    Break them if the part must stand alone

    Break All removes the references permanently; the lid keeps its current shape and can then be referenced to something new. Breaking cannot be undone.

Common mistakes

  • Opening an in-context part on its own and wondering why it does not update — references update only when the assembly is open (out of context is shown as ->?).
  • Long chains of parts referencing parts referencing parts. Changes ripple unpredictably and rebuilds slow down.
  • Breaking references when locking would do. Locking can be undone; breaking cannot.

Lesson 12 of 16 in the assemblies course.

Practice

Change the plate from 100 to 120 mm long with the lid's references active, then lock them and change the plate back. Check: with references active the lid becomes 36,000 mm³ (120 × 60 × 5); after locking, it stays 36,000 mm³ even when the plate returns to 100 mm.

Sources

Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.

Frequently asked questions

What does -> mean in the SOLIDWORKS tree?

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The item has an external reference. ->* means locked, ->x broken, and ->? out of context — the referenced document is not open.

How do I remove external references?

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Right-click the part or feature, choose List External Refs, and click Break All. This cannot be undone; Lock All is the reversible option.

How do I stop SOLIDWORKS creating external references?

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Turn on the No External References option while editing in the assembly. Features then capture positions without linking to other parts.

Are in-context references bad?

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Not in themselves — they are how top-down design works. But they are resource-heavy in large assemblies and make parts harder to reuse, so use them deliberately and lock them when the design is settled.