Assemblies · Lesson 8
SOLIDWORKS Interference Detection
Interference Detection finds places where components overlap — a bolt too big for its hole, a bracket that crashes into a cover — and lists each overlap with its volume. Run it before you release an assembly. Related tools check minimum clearances, whether holes line up between parts, and collisions while you drag components.

Where to find it
Evaluate tab → Interference Detection
Related checking tools
| Tool | Checks |
|---|---|
| Interference Detection | Overlapping volumes at the current position |
| Clearance Verification | Minimum gap between static components |
| Hole Alignment | Holes that should line up between parts |
| Collision Detection (Move Component) | Contact while dragging — stops or highlights at collision |
| Dynamic Clearance (Move Component) | Live minimum distance; can stop at a set clearance |
Version notes
| Version | Change |
|---|---|
| 2020 | Isolate an interference from the results |
| 2021 | Save results to Excel |
| 2025 | Surface-to-solid and surface-to-surface checks; works in Large Design Review |
Options let you include interferences inside multibody parts, treat subassemblies as single components, and exclude hidden bodies.
Practise it: check the mesh in the gearbox project and the joints of the robot arm.
Interfering bodies also stop Simulation meshes — see mesh failed.
Step by step
-
1
Create an interference on purpose
Make a third pin, Ø12 × 30 mm, and mate it concentric and coincident in one of the Ø10 holes of the plate.
-
2
Run Interference Detection
Evaluate → Interference Detection. The top-level assembly is already selected. Click Calculate.

Each interference is listed with the components involved and its volume. -
3
Read the results
Each interference is listed with the two components and the volume. Select it to highlight the overlap. Right-click to zoom to it, ignore it, or (since 2020) isolate it.
-
4
Fix and re-check
Replace the Ø12 pin with a Ø10 pin and calculate again — the result should read No interferences.
Common mistakes
- Treating touching faces as a problem. Coincident contact is not interference unless you set the option to treat it as one.
- Clicking Ignore on results without checking them — ignored interferences are easy to forget.
- Checking only the current position of a mechanism. Interference Detection checks one position; use Move Component with collision detection to check the range of motion.
Lesson 8 of 16 in the assemblies course.
Practice
Mate a Ø12 pin into a Ø10 hole in the 10 mm plate. Check: Interference Detection reports one interference of 345.58 mm³ — a ring with 12 and 10 mm diameters, 10 mm long.
Sources
- CATI — Interference Detection (Jun 2021)
- CATI — Interference Detection options
- Javelin — Interference with multibody parts
- Javelin — Isolate interference (2020)
- Javelin — Save interference results to Excel (2021)
- GoEngineer — What's new in SOLIDWORKS 2025 assemblies
- Javelin — Clearance Verification
- Hawk Ridge — Dynamic clearance in assemblies
- CATI — Hole Alignment
- Javelin — How to use Move Component (Mar 2026)
Checked November 2026. SOLID WORKS Club is independent; menu names can differ slightly between releases.
Frequently asked questions
How do I check for interference in SOLIDWORKS?
+
Evaluate → Interference Detection, select the assembly or components, and click Calculate. Overlaps are listed with their volumes.
How do I export interference results?
+
Since SOLIDWORKS 2021, Save Results exports the list to Excel, with optional thumbnails. Excel must be installed.
How do I check the gap between two parts?
+
Use Clearance Verification on the Evaluate tab to find the minimum clearance between static components, or Dynamic Clearance in Move Component while dragging.
How do I check that holes line up?
+
Hole Alignment checks Hole Wizard holes, simple holes and cylindrical cuts between components for misalignment.
Related
- SOLIDWORKS exploded viewHow to create an exploded view in SOLIDWORKS: regular and radial steps, auto-space, smart explode lines, animation, and showing the exploded state in drawings.
- Toolbox fasteners in assembliesHow to add bolts, nuts and washers to SOLIDWORKS assemblies with Toolbox: drag onto holes, change sizes, Smart Fasteners and configuration settings.
- SOLIDWORKS standard matesHow to use SOLIDWORKS standard mates: coincident, parallel, perpendicular, tangent, concentric, lock, distance and angle, Quick Mates and lock rotation.
- SOLIDWORKS Mass PropertiesHow to use Mass Properties in SOLIDWORKS: mass, volume, centre of mass and inertia, units, coordinate systems, overrides, Measure and Section Properties.